[Technical Ted]

OSP 700m

I need a can cycle that will rapid to Z.1 between holes to clear a hub, rapid to Z-.525 then drill to Z-1.2.
Here's a program from GibbsCam. Not sure where Z.43 came from. Which line should have the Z-.525?

%
O0001
N1 G17 G40 G80 G94
IF[VATOL EQ 1]NTC1
T1 M6
NTC1
G15 H1
S2000 M3
G90 G0 X5.75 Y0.
G56 Z.43 H1 M8
G71 Z.1
G81 X5.75 Y0. Z-1.2 R.1 P0 F4. M53
X-1.7768 Y-5.4686
Y5.4686
G0 Z2.
M9
G30 P1
X-18. Y12.
M30
%

[deadlykitten]

hi i would code this long hand; is possible to use an R value and obtain what you wish for using a cycle, but i can deliver this code faster than looking for those cycle codes inside the manual; also there are things that a cycle can not deliver, so ...

if you really wish for a can cycle, let me know, and i will be back with a code written how you wish / kindly

 
    IF [ VATOL EQ 1 ] NJUMP
         T1 M6
    NJUMP ( NOEX )

    M08
    G15 H1
    G56 H1
    S2000 M3
    G00 Z0.43

    CALL OSUB LV01 = xa LV02 = ya
    CALL OSUB LV01 = xb LV02 = yb
    CALL OSUB LV01 = xc LV02 = yc

    M05
    G00 Z0.43

M02

OSUB
 
  ( G00 Z0.1 )
    G00 X+LV01 Y+LV02
    G00 Z-0.525
    G01 Z-1.2 F? G95
    G01 Z-1.2+0.3/25.4 i guess your coordinates are in inches
    G00 Z0.1

RTS
 

[Technical Ted]

I would prefer to use the can cycle. I'm surprised nobody knows how off the top of their head. Maybe it can't be done with a can cycle.

[Superman]

I would prefer to use the can cycle. I'm surprised nobody knows how off the top of their head. Maybe it can't be done with a can cycle.

I would go
G56 Z.5 H1 M8
G71 Z.5
G81 X5.75 Y0. Z-1.2 R-.5 F4. M54
...

M54 forces return to G71 position
M53 forces return to R position

[deadlykitten]

hello super carefull sunshine, maybe M53 is for G71


hello technical teddy i have attached some infos from the manuals, related to your drilling stuff

code shared in this post uses G81 / kindly

  IF [ VATOL EQ 1 ] NJUMP
         T1 M6
    NJUMP ( NOEX ) (*4)


    M08
    G15 H1
    G56 H1
    S2000 M03
    G00 Z0.43
    G71 Z0.43


    G81 X10 Y10 Z-1.2 R-0.525 ( P+60/2000*0.6 ) F0.15 G95 M53 (*1)
        X20 Y20
        X30 Y30
  ( G00 )
    G80


  ( M05       ) (*3)
  ( G00 Z0.43 ) (*2)


M02


(*1) ( P : dwell time for 0.6 rotations, thus for 0.6*360=216 degrees )
     ( formula should contain actual rpm )
     ( formula may fail in case of override potentiometer <> 100% )
     ( in your code, from post 1, is no delay : P0 )
     ( you may avoid the delay for through holes, cut within 1 shot; if you peck, or if there is a blind hole, than delay a bit )
     ( also there are alternatives to delay, like the retreat movement among 0.3mm, in feed, shared in the code from post 2 )

(*2) ( no need to rapid up, because Z is allready @ safe Z, before executing G80 )

(*3) ( spindle was stopped when G80 was executed )
     ( if you wish to avoid spindle stopping, then remove the brakets from G00 that is before G80 )

(*4) ( check if it works to remove the brakets from NOEX )

[Superman]

I would go
G56 Z.5 H1 M8
G71 Z.5 (this sets the clearance plane )
G81 X5.75 Y0. Z-1.2 R-.5 F4. M53
...

M53 forces return to G71 position before next hole
M54 forces return to R position before next hole
.....
for each option
each I or Q peck retracts to R plane. so care is needed if swarf needs to be removed

oops

[Technical Ted]

I gave up & went with a long hand program instead of can cycle. Using either M53 or M54 I could get it to retract far enough but it always feed from that point instead of rapiding back to Z-.5 & feeding from there.

[deadlykitten]

hi technical teddy

I gave up & went with a long hand program instead

is good to code longhand, or at least to know the codes ...

Using either M53 or M54 I could get it to retract far enough but it always feed from that point instead of rapiding back to Z-.5 & feeding from there

i shared 2 codes in this thread : both rapid up + reposition + rapid in; one is long hand, the other has cycles

if you wish, use them as a reference / do you have questions about them ? i tried to write them as simple as possible

they are both tested on the machine, and they work / kindly

[Technical Ted]

I didn't realize you had tested the program on your machine & it worked. We loaded your can cycle program into our machine & it also worked for us. We then tried my program again & it also worked. Not sure why it didn't work the 1st time, maybe the other operator had the rapid override too low & thought it wasn't rapiding. Thanks for the help & sticking with me to get this resolved.

[deadlykitten]

hy teddy

I didn't realize you had tested the program on your machine & it worked

come on man, only looking at those codes : layout, indenting, paragraphs, comments, vertical alignments : doesn't it seem tested ? or you thought that i like caligraphy ?

caligraphy comes 2nd ... content is 1st do you wish for a messed up code ? just say it

We loaded your can cycle program into our machine & it also worked for us

improvements can be done:
... faster editing times
... shorter cycle without messing with the cutting specs
... random sh**t that delivers
* would work on osp300, maybe 200 ?

Not sure why it didn't work the 1st time, maybe the other operator had the rapid override too low & thought it wasn't rapiding

maybe is a good idea to test codes yourself, and when you are sure, pass it to the operator ... just saying

i am not telling you what you should do, but you seem more prepared with this stuff than your operator ...

Thanks for the help & sticking with me to get this resolved

is ok ... if somehow you get rich ( and famous ), and maybe you will have a spare lamborghini ...

kindly

[Technical Ted]

A Lambo doesn't seem like it would be practical in Antarctica.

[deadlykitten]

1:58 in here

https://www.youtube.com/watch?v=D8FTh_PLWRw