Printable View
Hello all,
I am running a Takisawa EX-110 lathe with a Fanuc 21i-T control. This is my program:
:0100
M98P0101
M98P0102
M98P0103
M30
What I want to do is loop through this program a specific number of times, (say 35 times) and then stop. I know you can use macros to create loops and logic and such but I have never used them. Could somebody help me with this problem?
Thanks a lot!
So many ways to skin this cat!Quote:
Originally Posted by crazycnc
You could write a short program:
:O1000
M98P0100L#500
M30
You'd have to end your original program with an M99 instead of an M30.
Then, enter the number of repetitions into your Macro Variable table at #500.
Not sure about the format for repetition values in the M98 line. Some controls are different there. Also, there's a limit to the depth of nested programs, so if you have subs in your subs, this might be problematic.
ok, thanks that makes sense. Now I'm trying to figure out how to set or even how to access my variable table....
ok, I found my variables. I would like to keep it all in one program if possible. If I were programming my computer, I would do something like this:
:0100
for(int i = 0; i < =35; i++) {
// call program 101
// call program 102
// call program 103
};
M30
Can I do something similar on the lathe?
#500=1
WHILE[[#500]LE[35.]]DO1
M98P101
M98P102
M98P103
#1=#1-1
END1
Just change the 35 to however many repeats you need. Set #500 in program. Just make sure your sub programs don't use #500 or WHILE loops...
DP
Should this be #1=#1+1? I am assuming 'LE' is 'less than or equal'?Quote:
#1=#1-1
Yep, you are quite correct, er, looks like I changed my mind halfway through didn't I - sorry 'bout that one.
DP
I ran this program and it didn't stop after 2 parts, just kept on going. I have to leave now, I'll be back in the morning. Thanks for all your input so far, might have a few more questions tomorrow.Quote:
:0100
#500=1
WHILE[[#500]LE[2.]]DO1
M98P101
M98P102
M98P103
#1=#1+1
END1
Aaaaah yes. I appear to have changed my mind twice in my original post...
Change it to #500=#500+1 and all will be well.
Made myself look a right clown there eh? I changed from local macros #1-#33 to common macros #500+ as I wasn't sure if the locals would be affected by jumping in and out of main program.
More often than not I spend longer debugging my programs than coming up with the original concept....
DP
Likewise,Quote:
Originally Posted by christinandavid
:O0100
#500=#500+1
IF [#500 GT 35] GOTO N999
M98P101
M98P102
M98P103
M99
N999M30
Damn, couldn't find a single mistake in your post, am I the only one with poor brain/finger co-ordination ('co-operation' may be the right word in my case)?...:)
Of course the GOTO method would also be the best way to go if you wanted to eliminate the need for sub programs.
DP
Hello.
Christian is right with his method. The only thing is though, 500 variables are not cleared until they are physically changed. Therefore use 100 variables.
:0100
WHILE[#100LE35]DO1
M98P0101
M98P0102
M98P0103
#100=#100+1
END1
M30
Fanuc Mate
That does the trick! Now, this is starting to give me big ideas...Will this work?Quote:
:0100
WHILE[#100LE35]DO1
M98P0101
M98P0102
M98P0103
#100=#100+1
END1
M30
:0100
WHILE[#100LT[[#500-2.875]/1.312]]DO1
M98P0101
M98P0102
M98P0103
#100=#100+1
END1
M30
I will store the length of my bar in #500. 1.312 is the amount the bar gets pulled in every cycle of the main program, 2.875 is the length of the 'remnant'
part of the bar when I'm done. I'll try it but will probably run into problems. Can I nest brackets like I did? Will it be able to compare an 'integer' with a 'floating point'? Guess I'll find out...
Yep, you can do all sorts of crazy sh!t...you can nest brackets, hell you can nest while loops too.
I tend to go a bit overboard with my bracketing, especially when a / is lurking about. I would probably put something way OTT like [[#100]LT[[[#500]-[2.875]]/[1.312]]] then spend the next half hour playing with it 'til it gave me the correct result...
DP
Parameters may sometimes play havoc which you may never expect.
For example, 6001#7 and 6001#6, when set to 1, retain local and common variables, respectively, even after system reset.
So, it is a good practice to always initialize the variable you are going to use.
Im a little late and see that you already have a solution, but here is another option
:0100
M98P0101
M98P0102
M98P0103
M99
:0099
M98 P???0100
M30
In your program 100 change the M30 to M99
Program 99 would tell it to run program 0100 ??? amount of times. and ??? has to be 3 digit...so P0010100 would run program 100 1 time and P9990100 would run program 0100 999 time. we uses it al the time on our Fanuc OT lathes.
You may never need this information, but ...
For repetition count over 999, use L-method which allows up to 9999 repetitions.
(M98 P0100 L9999 repeats O0100 sequentially, 9999 times)
Sinha
I know that I'm digging this thread up from the grave but I got a ? about looping a pgm and limiting the amount of times that it loops. On a HAAS control I would do this:
O6666
M97 P100 L20
N100 M11
G91 G28 Z0.
G28 X0. Y0. B0.
S1000 M3
G0 G91 X-13. Y-12. Z-9. B180. S2000 M3
X-26. Y-1. Z-18. B300. S3000 M3
X-13. Y-12. Z-9. B180. S4000 M3
G91 G28 Z0.
G28 X0. Y0. B0.
M10
M60
M30
This is just a simple warm up pgm that will run the machine thru it's axies.
I will define the M97 line as thus:
M97 (internal skip or sub pgm run)
P100 (start @ N100 line)
L20 (loop 20 times)
What I want to do is let this pgm run 20 times and stop.
Thank you for any help.
M97 is not a valid M-code on a standard Fanuc control.
if you don't want to use macro or advanced techniques like those
above you can use a sub program to repeat it...
O6665
M98 P6666 L20
M30
O6666
N100 M11
G91 G28 Z0.
G28 X0. Y0. B0.
S1000 M3
G0 G91 X-13. Y-12. Z-9. B180. S2000 M3
X-26. Y-1. Z-18. B300. S3000 M3
X-13. Y-12. Z-9. B180. S4000 M3
G91 G28 Z0.
G28 X0. Y0. B0.
M10
M60
M99
Thanks ill give that a try