Angle/Degree

https://www.upload.ee/image/4147893/Angle.png


I learn CNC code and I have a question.

I try to make 15 Degree and 0.75 (center)
My code is:

G97 M08;
G54 T S;
G0 Z2.;
X80. (How to calculate start point?)
G01 Z0.06 F0.2;
A105. X82. F0.05;

noseR is 0.4

http://www.upload.ee/image/4150371/Angle.png

Tangent(15) X (.5) = .133975

How did you get .133975
I got 2.7060
Explain please.

And what is X?

Your going to have to give more information than what your showing.

Draft:
http://www.upload.ee/image/4150371/Angle.png

Program
G97 M08;
G54 T S;
G0 Z2.;
X80. (How to calculate start point?)
G01 Z0.06 F0.2; OR Z0. ?
A105. X82. F0.05;

noseR is 0.4

Or what is the correct and accurate program?

Quote:

---

Originally Posted by Readme00

How did you get .133975
I got 2.7060
Explain please.

And what is X?

---

If you refer to the attached diagram, you will see that the radial value for X can't possibly be greater than the Z value of the chamfer. The two known components are the angle of 15deg and the side adjacent to the angle. What you don't know, and need, is the side opposite the angle. As the Tan of an angle equals the ratio of the opposite and adjacent sides of a Right Triangle, you can use the Tan trig function to solve the length of the opposite side X in the diagram.

Attachment 242580

Tan 15 = X / 0.5
Tan 15 x 0.5 = X
X = Tan 15 x 0,5
X = 0.133975

X solved in the above is a radial value, therefore, multiply by 2 to obtain the diameter value of 0.26795

To get the X value of the start of the chamfer:

X = 82.0 + 0.26795
X = 82.26795

Regards,

Bill

Thanks for the help Bill,
Looking at the Print and the code was a little confusing. It looks like a cross section of a 82mm dia.
plate with a .5 +.5/-0 chamfer and the code he shows looks like milling code. He also is showing a tool Rad.
of .4, which confused me as to what he wanted to calculate for. He's showing in his code A105 X82. which
looks like a polar move to the O.D. which would make the start point X80.5 (82 - (2 x mean chamfer size of .75)).
I'm not sure if he's looking to calculate for the tool radius either. If it's a mill, His code is showing X82. which seems
like the print is not oriented correctly. It may help if the OP provided more info as to machine type and what he is
trying to do. Thanks again, and by the way I've enjoyed reading many of your solutions you've posted.

Mark

Hi Mark,
Having another look at the OP's code I see what you mean.

To the OP
Following is how to calculate the start and finish coordinates for a 0.4 rad Tool Nose Radius.

Referring to the attached picture:

Attachment 242582

1. Solve Z1
Z1 = Tan 15 x 0.5
Z1 = 0.133975

2. Solve X2
X2 = Tan 7.5 x .4
X2 = 0.052661

3. Solve Start X Pos of Tool
X Start = 81 + X2 x 2 - 0.8
X Start = 81 + 0.052661 x 2 - 0.8
X Start = 80.305322

4. Solve Z3
Tan 52.5 = Z3 / 0.4
Z3 = 0.4 / Tan 52.5
Z3 = 0.306931

5. Solve Finish Z Pos of Tool
Z Finish = (-Z1 + Z3) - 0.4
Z Finish = (-0.133975 + 0.306931) - 0.4
Z Finish = -0.227044


N1 G00 X78.000 Z1.000
G01 Z0.000
G01 X80.305
G01 X82.000 Z-0.227

Regards,

Bill

http://www.upload.ee/image/5397030/angle.png

How to calculate degrees, if:
X1 50.9
X2 48

The correct degree is 2.51592 (Mastercam) but I want to know how to calculate it.

tan(phi) = 1.45 / 33 = 0.043939...
phi = atan(0.043939...) = 2.51592 deg

1.45: difference of the two diameters 50,9 and 48 divided by 2 (i.e. difference of the radii)

Thanks

Quote:

---

Originally Posted by CNCFr

tan(phi) = 1.45 / 33 = 0.043939...
phi = atan(0.043939...) = 2.51592 deg

1.45: difference of the two diameters 50,9 and 48 divided by 2 (i.e. difference of the radii)

---

How to You Get 33