[iaknown]

Hello all, my 1993 Mighty VMC-510P with the Meldas 320 just took a crap and I had to reinitialize the control, put all the parameters back, and format the memory. In doing so the toolchange program/macro got erased. I have all the documentation to the machine with the parameters/settings but they left out this important information.

Does anybody have one of these up and running?? If so I am desperate for this program as I cannot get my machine going without it. It should be program O9890. It may be hidden but I can tell you how to access it. Or I believe you can just output that program whether it's visible under the File page or not. Please help! My machine is useless without it so any assistance is much appreciated!!

[iaknown]

Make that program O9020 not O9890.....

[iaknown]

And here is how to find it: Access machine parameters, which is going to diagnosis screen, press the PLC I/F soft key. Then type in the following Device (1001) Data ( ) Mode (M) press input, they will disappear. Then press your parameter hard key. Under the Base parameters look for a parameter edlk_C and change it to a 0. Then go to the file page and it should be there.

I will pay someone for this guys!!

[dblox]

I have a Hartford VMC850 with a Meldas M520A controller, I was hoping it was similar because I'd like to tweak my toolchange program, but my edlk_c param is already 0 and I cannot access any macro programs. I'll dig out the manual and see if I can help you in any way.

Edit: Found a helpful website "If you inadvertently lose the FIXED CYCLES, they are still stored on EEPROM so all you need to do is change FIX_P to 1, go to INPUT screen and enter #(4) and press INPUT. The FIXED CYCLES will be loaded from EEPROM."
Not sure if that will help? http://machinetoolinfo.com/MITSUBISHI.html
This might be similar to the program you are seeking http://www.cnczone.com/forums/fanuc/...acting_up.html or something like http://machinetoolinfo.com/YANG.html

Good luck and let us know if any of this was helpful. Program 9001 on that last link looked promising

[dblox]

Taken from this forum: http://www.cnczone.com/forums/mazak_...control-2.html
But for the 520 control.
%
O9001()
N1#1=#4003
N2#2=#4001
N3#3=#1033
N4#4=#4120
N5IF[#4LE0]GOTO20
N6IF[#4GT18]GOTO20
N7IF[#3EQ#4]GOTO20
N8G40G80G63
N9M60
N10G91G30Z0M19
N11M40
N12G04P500
N13M12
N14G04P500
N15G91G28Z0
N16M41
N17G30Z0
N18M11
N19M42
N20G#1G#2
N21G64
N22M99

%

The M codes in whichever program you try to use might need to be changed to your specific machine. Do you have a manual with the M codes listed for tool clamp, magazine in / out etc?

[iaknown]

I have a Hartford VMC850 with a Meldas M520A controller, I was hoping it was similar because I'd like to tweak my toolchange program, but my edlk_c param is already 0 and I cannot access any macro programs. I'll dig out the manual and see if I can help you in any way.

Edit: Found a helpful website "If you inadvertently lose the FIXED CYCLES, they are still stored on EEPROM so all you need to do is change FIX_P to 1, go to INPUT screen and enter #(4) and press INPUT. The FIXED CYCLES will be loaded from EEPROM."
Not sure if that will help? MITSUBISHI
This might be similar to the program you are seeking http://www.cnczone.com/forums/fanuc/...acting_up.html or something like YANG

Good luck and let us know if any of this was helpful. Program 9001 on that last link looked promising

Thanks, I will check these links out. As far as the fixed cycles on the eeprom, I was able to do that and got all my canned cycles back. But no tool change program unfortunately.

It's interesting you mentioned that you set your 520 edlk C off and still can't see the program. We have a newer Mighty Viper here with the 520 and the same thing happens, I can't see the tool change program at all. Weird thing is at some point I remember changing a setting or parameter on the same machine and seeing it executed step by step. But I don't remember what we did. I also found an identical machine to mine in Green Bay with the 320, and the shop was willing to help me, so I thought problem solved. But again they can't see or find the program either. Does anyone know why this is?? Is it written into the PLC side or something?

[iaknown]

Taken from this forum: http://www.cnczone.com/forums/mazak_...control-2.html
But for the 520 control.
%
O9001()
N1#1=#4003
N2#2=#4001
N3#3=#1033
N4#4=#4120
N5IF[#4LE0]GOTO20
N6IF[#4GT18]GOTO20
N7IF[#3EQ#4]GOTO20
N8G40G80G63
N9M60
N10G91G30Z0M19
N11M40
N12G04P500
N13M12
N14G04P500
N15G91G28Z0
N16M41
N17G30Z0
N18M11
N19M42
N20G#1G#2
N21G64
N22M99

%

The M codes in whichever program you try to use might need to be changed to your specific machine. Do you have a manual with the M codes listed for tool clamp, magazine in / out etc?

Thank you also. As far as the M codes go, I don't have the manual with me at the moment, but I think I'll be able to figure them out. Someone also posted the M codes and what they do on their Mighty some time back. What I don't understand is the rest of the program, the assignments to the registers and whatever else is going on there. Does anyone know how to decipher what's going on line by line?

[iaknown]

Forgot to mention, the mill is also known as a Mighty Comet, I probably should have added this in the title....

[dblox]

I'm 99% sure that Mighty Comet / Might Viper & Hartford are all the same MTB HARTFORD INDUSTRIAL CO., LTD-www.hartford.com.tw so you could try asking them for some info. Is there a little plaque on the machine from the builder? In all the google searches I do the Mighty Viper looks like my Hartford machine.

[iaknown]

I'm 99% sure that Mighty Comet / Might Viper & Hartford are all the same MTB HARTFORD INDUSTRIAL CO., LTD-www.hartford.com.tw so you could try asking them for some info. Is there a little plaque on the machine from the builder? In all the google searches I do the Mighty Viper looks like my Hartford machine.

Hmmmm....As far as I know the Mighty Viper (late 90s?) was the next generation VMC after the Comet. I have never seen that name Hartford on anything on my machine but it is worth taking another look. I will check out the plaque this weekend.

[dblox]

Hartford and Mighty Viper are just brand names, looks like Mighty Viper is the sticker they put on for the American market. Mighty USA even has the link to Hartford, which is actually She-Hong industrial which is the name I'd expect to see stamped on the back of your machine sheetmetal. Mighty USA
With this in mind, contacting She-Hong is probably your best bet.

[iaknown]

I am in the process of talking to Mighty service techs but not sure how that is gonna go, depends on if they can dig up the program or not....

But in the meantime, for anyone that has one of these Comets with the 320M, or can get access to the correct program from it, I will Paypal you $250 (providing it works of course). I need it that bad. Let me know if anyone can help.

[digidem]

Just private messaged you. Guessing you probably have the tool changer program by now, but if not, I've got it.

[digidem]

Ok, I'll email you the program later tonight.

I sent another message to you requesting some advice. I'm restoring a 510P right now, which lost its parameters. Probably going through exactly what you had to, and a little confused with some things. I'm willing to pay for help.

[guhl]

I have managed to create macro for tool change on Comet VMC-750P. It works. Before using this macro make sure you set corresponding parameters properly:
"Machine parameters -> Macro -> M[01] = 6; type = 1; pogram = 9020"
To perform tool change type M6 Tx (x = tool #). Not Tx M6
%
O9020()
#1=#4003 (Store modal info)
#2=#4001 (Store modal info)
#3=BIN[#1033] (Tool in spindle. "#1033" from ladder)
IF[#20LE0]GOTO20 (Checking what # of tool was typed)
IF[#20GT20]GOTO20 (Checking what # of tool was typed)
IF[#20EQ#3]GOTO20 (Checking what # of tool was typed)
G49G40G80M5 (Corrections, cycles, spindle off)
M9 (Coolant off)
T[#3] (Turn empty pot to spindle)
G91G28Z0M19 (Go to tool change position, orient spindle)
M82 (Changer advance toward spindle)
M11 (Unclump)
G4X.50M53 (Blow ON)
G30Z0 (Take out tool)
T[#20] (Turn to desired tool position)
#1132=2049 (First action for saving tool # in SP register)
G28Z0 (Take in tool)
M10 (Clamp)
G4X.50M54 (Blow OFF)
M83 (Changer retract from spindle)
#1132=2052 (Second action for saving tool # in SP register)
G4X.5
M92 (Third action for saving tool # in SP register)
N20G#1G#2S50 (Restore modal info and cancel orientation)
M99
%