[colby2000]

Hello,
I've got a question regarding Citizen K/16E.
I want to program just the main to face a piece which is .250 dia. Then turn to .120 dia. and 3.750 long. Then I'm just going to manually cut off.
So I'm not using the sub at all. When I try this I'm getting error stating $2 is blank. Will G600 fix this. Or can someone show me code I need to use just the main spindle.
Thanks

[carmstrongls1]

No, G600 will just cancel and run independently. You are going to use a catcher of some sort? Like an A-16 or B-12 machine has?

I can help you program it but there will need to be commands in $2 to at least explain there is nothing going on but wait and loop.

Even if you aren't using the actual catcher you can get the part from the bottom of the machine. I recommend you get the catcher attachment. On simple single sided turning operations it works great and saves a ton of time machining without the need to sync. Just be careful in setups and remembering its in the machine.

M320-(macro) Parts catcher command. Used when the parts catcher is attached
to the sub spindle and the sub spindle is not used. To use this command
you need to have Machining Data set to "Catcher". Also we have to be in
G600 mode. Use M320 in $1 only. At this time M320 does not work while in
G610 so if using M320, you must use G600 mode.

M320 X.2 W0 U24.881 Z5.708 R1 F708.

M320 -nothing else on line then catcher move up to catch part with
default positions. This usually works fine.

X.2 -When X1 gets to .2 then bring the catcher up. Less chips
in the catcher.
W -After the part is caught then the catcher moves back to Z0
or the amount of W from Z0. Used if Parts per 1/chucking is
used to save time. Normally not used.
U -Used to change the position of X2 . 24.881 positions the
catcher into a standard position. Normally don't use.
Z -Used to change the position of Z2 . 5.708 positions to the GB.
Normally don't use.
R -"1" or "0" If "1" then Z2 positions back a little to accommodate
for a left hand cut-off tool. You could use Z instead of R.
Normally not used.
F -Feed rate for the Z2 axis. Usually rapid so don't use.

$1

G600
"
T0200(ANY GANG TOOL)
M34(dump part/ see M34)
"
T0100(CUT-OFF)
G50W-.094
G0X1.1Z1.T01
(if chamfer put here)
M320X.2 (catch part when X=.2)
G1X-.1F.002
M141(MOVE Z2 BACK)
G50W.094
G600


$2

G600
(No T3?00 in $2 or $1 M34 won't work)

G600
G50Z0

[nickydoyl]

MAy be im reading your question wrong but when my $2 is not doing any thing i leave it like this

$2
G50X160.0Z0.0
G730W1
G750
G730W1
G999
N999
M2
M99

[cogsman1]

If you are NOT using any "G600" codes in $1 then your $2 would just be;

$2
M2
M99

DONE!