[jbranting]

I can't figure out what is wrong with my code, with one it works fine, the only difference i made was changing tools, the x and y coordinates have been changed but the rest of the subroutine programming is identical, unless im missing something, the code with the 3/4 end mill runs through fine but when it changes tools and begins second subroutine it follows tool 1's toolpath, please help! here is code snippets for both

(working version)
(1/2" ENDMILL)
N2L100
N3G8
N4G90G0X0Y0
N5X1.1536Y-0.4
N6Z0.5
N7Z0.12
N8G1Z0F90.
N9G41D1X-1.1536
N10G0Z0.5
N11X1.1536Y-0.05
N12Z0.12
N13G1Z0
N14X-1.1536
N15G0Z0.5
N16X1.1536Y0.3
N17Z0.12
N18G1Z0
N19X-1.1536
N20G0Z0.5
N21X1.1536Y-0.4
N22G0Z0.5

N23(ROUGH PART)
N24X0.96Y0.7371
N25Z0.12
N26G1Z-0.225F90.
N27Y0.2871
N28Y-0.2871
N29G40Y-0.7371
N30G0Z0.5
N31X0.61Y0.7371
N32Z0.12
N33Z-0.225
N34G41G1D1Y0.2871
N35Y-0.2871
N36G40Y-0.7371
N37G0Z0.5
N38X0.96Y0.7371
N39Z-0.175
N40Z-0.52
N41G41G1D1Y0.2871
N42Y-0.2871
N43G40Y-0.7371

N44G0Z0.5
N45X0.61Y0.7371
N46Z-0.175
N47Z-0.52
N48G41G1D1Y0.2871
N49Y-0.2871
N50G40Y-0.7371
N51G0Z0.5
N52X-0.96
N53Z0.12
N54Z-0.225
N55G41G1D1Y-0.2871
N56Y0.2871
N57G40Y0.7371
N58G0Z0.5
N59X-0.61Y-0.7371

N60Z0.12
N61Z-0.225
N62G41G1D1Y-0.2871
N63Y0.2871
N64G40Y0.7371
N65G0Z0.5
N66X-0.96Y-0.7371
N67Z-0.175
N68Z-0.52
N69G41G1D1Y-0.2871
N70Y0.2871
N71G40Y0.7371
N72G0Z0.5
N73X-0.61Y-0.7371
N74Z-0.175
N75Z-0.52
N76G41G1D1Y-0.2871
N77Y0.2871
N78G40Y0.7371

N79G0Z0.5
N80X-0.72Y-0.6955
N81Z0.12
N82Z-0.64
N83G41G1D1Y-0.2455
N84Y0.2455
N85G40Y0.6955

N86G0Z0.5
N87X0.72
N88Z0.12
N89Z-0.64
N90G41G1D1Y0.2455
N91Y-0.2455
N92G40Y-0.6955
N93G0Z0.5
N94X0Y0
N95M17


N96L200(1/2" BULLNOSE E.M.)
N97G90G0X0Y0
N98X1.405Y0.1321



N330(1/2 FLAT ENDMILL TOOL - 1 DIA. OFF. - 1 LEN. - 1 DIA. - .5)
N331(FACE TOP)
N332G8
N333T1M6
N334M3S6000
N335G90G0X0Y0E1
N336Z1.H1M8
N337Z0.5
N338L101
N339G90G0X0Y0E2
N340L101
N341G90G0X0Y0E3
N342L101
N343G90G0X0Y0E4
N344L101
N345G90G0X0Y0M9
N346M5
N347M1


(non working)

N2L100
N3G8
N4G90G0X0Y0
N210 X1.1536 Y-.2768
N6Z0.5
N7Z0.12
N8G1Z0F50.
N240 G1 Z0. F20.
N250 G41 D1 X-1.1536 F26.
N260 G0 Z.5
N270 X1.1536 Y.175
N280 Z.05
N290 G1 Z0. F50.
N300 X-1.1536 F26.
N310 G0 Z.5
N320 ( ROUGH PART )
X.735 Y.9621
N230 Z.05
N240 G1 Z-.52 F50.
N250 G41 D1 Y.2871 F19.
N260 Y-.2871
N270 G40 Y-.9621

N280 G0 Z.5
N290 X-.735 Y-.9621
N300 Z.05
N310 G1 Z-.52 F50.
N320 G41 D1 Y-.2871 F19.
N330 Y.2871
N340 G40 Y.9621

N350 G0 Z.5
N370 X-.845 Y.9205
N380 Z.12
N390 G1 Z-.64 F50.
N400 G41 D1 Y.2455 F26.
N410 Y-.2455
N420 G40 Y-.9205

N430 G0 Z.5
N440 X.845 Y-.9205
N450 Z.12
N460 G1 Z-.64 F50.
N470 G41 D1 Y-.2455 F26.
N480 Y.2455
N490 G40 Y.9205

N93G0Z0.5
N94X0Y0
M17

N96L200(1/2" BULLNOSE E.M.)
N97G90G0X0Y0
N98X1.405Y0.1321


N330(3/4 FLAT ENDMILL TOOL - 1 DIA. OFF. - 1 LEN. - 1 DIA. - .75)
N331(FACE TOP)
N332G8
N333T1M6
N334M3S2500
N335G90G0X0Y0E1
N336Z1.H1M8
N337Z0.5
N338L101
N339G90G0X0Y0E2
N340L101
N341G90G0X0Y0E3
N342L101
N343G90G0X0Y0E4
N344L101
N345G90G0X0Y0M9
N346M5
N347M1

[jbranting]

Is it maybe a cutter comp cancelling error? the part is 1" wide and part offset is center, it should have plenty of room but I guess I can try moving y further away from the part and see if that fixes it. i just dont get why it would repeat tool 1's path on tool 2

[stucapco]

First of all, lose the line numbering, its confusing. What I see is your calling the same dia offset register for both tools. Copy/paste here.

N9 G41 D1 X-1.1536

(not working)

N250 G41 D1 X-1.1536 F26.

3/4 and 1 inch tools if I read this right.

I suggest (just looking down this quickly) you should keep movement code in subs and command the individual cutter code in mains.

O001;
N1 M1;
G54 X0 Y0 S500 M3;
G43 H1 Z.05 M8;
G01 Z-.5 F1.;
M98 P3 D1 F1.; (L, whatever)
G0 Z1. M9;
T2 M6;
N2 M1;
G54 X0 Y0 S500 M3;
G43 H2 Z.05 M8;
G01 Z-.5 F1.;
M98 P3 D2 F1.;
G0 Z1. M9;
G49 G54 Y0 Z0;
M30;

The sub here is then ordered follow the instruction of modal misc. functions from the main.

O0003;
G01 X-1. G41; (NOTE, I have set the feed and dia offset form the main)
G02 I1.;
G01 X0 G40;
M99;

DO NOT USE THIS CODE!
It is an example of the topic. 1/2 inch deep, 2 inch circle, using the main and 2 different cutters following the same sub routine. Assumes correct height/dia offsets in the corresponding registers.

WOW! I hope I'm helping!

I tend to downsize code whenever possible, easier on all aspects, programmer, post (debugging, back plotting, etc), operator. The machine is ignoring much of your code (modal, not needed).

This off the top of my head.

[jbranting]

They have the same diameter offset because i replaced the 1/2 in flat end mill with a 3/4 trying to speed up the op, getting pushed to speed things up. I will definitely try your suggestions, thanks a bunch! Ill update in a bit after i try it.

[jbranting]

the 1-DIA is just saying which tool the diameter belongs to, it says 1/2 right after

[jbranting]

I changed it to "movement code in subs and command the individual cutter code in mains" works great, thank you very much, saved me just over a minute an op changing to that cutter! still weird that is the only tool i had to do it with, the other 6 tools are programmed like i originally had this one and they run fine.

[jbranting]

heres what it looks like now


L100
G8
G90G0X0Y0M3S4000
X1.1536 Y-.2768
H1 Z.5 M8
Z0.12
G1Z0F50.
G1 Z0. F90.
G41 D1 X-1.1536 F66.
G0 Z.5
X1.1536 Y.175
Z.05
G1 Z0. F90.
X-1.1536 F66.
G0 Z.5
( ROUGH PART )
X.735 Y.9621
Z.05
G1 Z-.52 F90.
G41 D1 Y.2871 F66.
Y-.2871
G40 Y-.9621

G0 Z.5
X-.735 Y-.9621
Z.05
G1 Z-.52 F90.
G41 D1 Y-.2871 F66.
Y.2871
G40 Y.9621

G0 Z.5
X-.845 Y.9205
Z.12
G1 Z-.64 F90.
G41 D1 Y.2455 F66.
Y-.2455
G40 Y-.9205

G0 Z.5
X.845 Y-.9205
Z.12
G1 Z-.64 F90.
G41 D1 Y-.2455 F66.
Y.2455
G40 Y1.3

G0Z0.5
X0Y0
M17

and...

T1M6(3/4 FLAT ENDMILL TOOL - 1 DIA. OFF. - 1 LEN. - 1 DIA. - .75)
G90G0X0Y0E1
Z0.5
L101
G90G0X0Y0E2
Z0.5
L101
G90G0X0Y0E3
Z0.5
L101
G90G0X0Y0E4
Z0.5
L101
G90G0X0Y0M9
M5
M1

[stucapco]

YES! I can't believe I actually helped, my post was some dry reading. Another tool in the arsenal.