584,798 active members*
4,320 visitors online*
Register for free
Login
Results 1 to 13 of 13
  1. #1
    Join Date
    Apr 2019
    Posts
    13

    lynx 200 Question

    Hi all
    brief intro
    Live in Australia, Queensland, Goldcoast.
    I'm a qualified fitter turner with cnc experience since 1988
    Machine controllers used; Haas and Fanuc.
    Machine types
    Lathes Mill turn with c and y axis.
    3,4 axis vertical machining centers
    5axis horizontal machining center

    I'm hoping the knowledge bank here can help.
    I have recently got the use of a Daewoo Lynx 200 with 21tb controller 2 axis lathe.
    nicknamed "the nugget"
    so far I have changed from workshift to work coordinates aka G54,G55 etc
    type 2 turning cycle for plunge profile turning in G71
    drill pecking/clearance G83
    but cannot get rigid tapping to work.
    I have tried all the combinations of m29s*** before G84,in the same line etc
    but continue to get the same result
    G84 on it's own taps but for floating holder only.
    Engage the m29 the tap gets to the position and just does nothing apart from the spindle having some load/Resistance until I reset the spindle rotates freely.
    parameters I think are original install from factory, I have backed up the file several stages along the way

    My only experience with rigid tapping has been with Haas Machines, it's either on or off kind of feature.

    Q can this Nugget actually rigid tap?


    Regards
    Jorg

  2. #2
    Join Date
    May 2019
    Posts
    1

    Re: lynx 200 Question

    Hi Jorg,

    In MDI mode, input M29S100, see if it alarms out.
    its' one indication that it'll either have or does not have rigid tap.

    Best regards,

    Wen.

  3. #3
    Join Date
    Sep 2008
    Posts
    87

    Re: lynx 200 Question

    The Doosan documentation is awesome. Print this out:
    Download PDF Doosan NC Programming Manual for Turning Centers Fanuc 30 Series Controls - CNC Manual

    page 96 of the manual has the G84 cycle. It looks like its optional on 2 axis lathes. My old 2 axis Daewoos don't have it.
    If you don't have it then you will have to use a floating tap holder.

    https://i.imgur.com/qpBUhvf.png
    https://i.imgur.com/ec2nmBE.png

  4. #4
    Join Date
    Jul 2005
    Posts
    380

    Re: lynx 200 Question

    Generally, any Doosan/Daewoo built AFTER 2011 will have rigid tapping as standard. It was optional before that.
    The MDI test is valid. If it alarms, you don't have it.
    All is not lost. You can tap in IPR mode (G99) and it's pretty close to rigid tapping.
    Let me know.

  5. #5
    Join Date
    Apr 2019
    Posts
    13

    Re: lynx 200 Question

    Hi Thanks for the reply.
    I'll give it a go with the mdi option.
    from memory when m29s200 was programmed it just sat there with no alarm.

    I have also found a trouble shooting guide with parameters that are associated with rigid tapping,
    however they do not go into detail of how to set them.
    It would be good to see a copy of parameters from a 21tb lathe that has rigid enabled.

    Thanks avongil for the pdf , very interesting format for the g84 definitely will be testing this.

    DouglasR I have ordered a floating tap holder as a backup, fingers crossed it will rot in the cupboard.


    regards
    Jorg

  6. #6
    Join Date
    Jul 2005
    Posts
    380

    Re: lynx 200 Question

    Very good. Let me know.

  7. #7
    Join Date
    Apr 2019
    Posts
    13
    Quote Originally Posted by Mr-Li View Post
    Hi Jorg,

    In MDI mode, input M29S100, see if it alarms out.
    its' one indication that it'll either have or does not have rigid tap.

    Best regards,

    Wen.
    tried this and no alarm
    I see hope....

  8. #8
    Join Date
    Apr 2019
    Posts
    13
    Quote Originally Posted by DouglasR View Post
    Very good. Let me know.
    "G97S250 M29 P11
    G99G84Z-0.625 F0.0625"
    I used this format but in metric
    again the machine gets to the position and sits

    attached is current parameters if anyone could shed some light ?
    regards
    Jorg
    Attached Files Attached Files
    Last edited by Jorg_Aussie; 05-13-2019 at 04:49 AM.

  9. #9
    Join Date
    Apr 2019
    Posts
    13

    Re: lynx 200 Question

    Weird I can't see the attached file from any other pc, nor can I edit the post above...

  10. #10
    Join Date
    Jul 2005
    Posts
    380

    Re: lynx 200 Question

    OK, If no alarms then the machine has the option.

    There are some key factors in rigid tapping on Doosan lathes -

    1) You always start rigid tap from a DEAD STOPPED spindle. Always.

    2) Tapping in Z axis is always done with a G84.

    3) Both G84 and M29 are cancelled with a G80.

    So your program syntax should look like this -

    M5 (Main Spindle Stop)

    T0202 (Tap)
    G0 G54 G99
    G97 S150 M29 (RIGID TAP ON)
    X0 Z.25
    G84 Z-.75 F.05
    G80 Z6.
    G28 U0
    ETC..

    Note that the rigid tap is around 150 rpm. You can tap from 100 up to 2000 but it's not recommended to go too high as the machine will never reach it's designated rpm and the spindle loads will max out into the red. I usually rigid tap from about 100 to 250 rpm. More than adequate.

    Note that the machine is in IPR mode and that makes the thread lead 1/#of tpi. So for 1/4-20 threads, the "F" thread lead is 1/20 or F.05!

    Note that the tool is starting at .25" in front of the part not .1. This is done deliberately as it gives the machine a chance to get the spindle up to speed/power it needs. Many rigid tap problems occur because the tap is so close to the part, the machine isn't able to accelerate properly before the tool is engaged and the load goes sky high. Giving it a .25 clearance allows the machine to tap properly.

    Rigid tap can also be left handed! Insert a M76 (spindle polarity reverse) on a line by itself BEFORE the G97 S150 M29 line. M77 is Spindle polarity normal and that is inserted AFTER the G80 line also by itself.

  11. #11
    Join Date
    Jul 2005
    Posts
    380

    Re: lynx 200 Question

    One more thing. If your machine has only a main spindle, or was built prior to 2011, eliminate the "P11" from the M29 line.

  12. #12
    Join Date
    Apr 2019
    Posts
    13
    Quote Originally Posted by DouglasR View Post
    One more thing. If your machine has only a main spindle, or was built prior to 2011, eliminate the "P11" from the M29 line.
    Hey thanks DouglasR for your reply. It seems email notification isn't working for me either.
    Yep she's a 1999 model doosan,
    somehow rigid tapping may not be tuned in properly as I followed your eg with the exception of metrification and the program runs until the g97s100m29 command, then it does absolutely nothing like a deer in the headlights.
    Pressing cycle start won't pass the line either so a reset is required.
    the spindle rotates easy by hand when "stuck"
    I was hoping to see someones param list of a similar machine to compare.
    thanks anyway .
    I'll keep hunting.
    regards
    Jorg

  13. #13
    Join Date
    Apr 2019
    Posts
    13
    re upload param list????
    Attached Files Attached Files

Similar Threads

  1. Doosan Lynx Tool Probe Question?
    By colton_m in forum Daewoo/Doosan
    Replies: 3
    Last Post: 07-14-2013, 12:45 PM
  2. Lynx 200L Programming Question
    By wganders in forum Daewoo/Doosan
    Replies: 1
    Last Post: 06-03-2009, 02:27 AM
  3. Lynx 220 "Z" G54 question
    By cinci5 in forum Daewoo/Doosan
    Replies: 5
    Last Post: 02-11-2009, 08:08 PM
  4. Lynx 220A question
    By PBMW in forum Daewoo/Doosan
    Replies: 5
    Last Post: 12-27-2006, 01:24 AM

Tags for this Thread

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •