[CNCRim]

Anyone know how to get Surfcam spit out long hand can cycle? Right now, it going like this G98 G81 Xxx Yxx R.1 and because I have home made machine will not understand can cycle and it only will take do simple G0 G1 G2 G3

Example:

G0 Xxx Yxx
G1 Zxx
G00

Etc....


Help me !

I know Mastercam can do that....... I want to understand it with Surfcam. Thanks

[mariojl]

Hi CNCRim:
Here is the answer for you, from the Surfcam Help Book

Emulated Can Cycles:
When built-in machine canned cycles are not available, the cycles can include any desired code that is to be repeated at each location. Since these cycles are not built-in canned cycles, the machine tool does not require a Cancel code. Define a straight drilling cycle by describing the Drill sequence as follows:

Drill

G0 X[h] Y[v] Z[rplane] # Rapid to position Rplane.

Z[vclear] # Rapid down to clearance.

G1 Z[d] F[plunge] # Feed down to bottom.

G0 Z[rplane] # Rapid out to Rplane level.

End


The output code:

G0 X1. Y1. Z.2

Z.1

G1 Z-.5 F5.

G0 Z.2

G0 X2. Y3. Z.2

Z.1

G1 Z-.5 F5.

G0 Z.2

G0 X3. Y4. Z.2

Z.1

G1 Z-.5 F5.

G0 Z.2

-.-.-.-.-.-.-.-.-.-.-.-.

Good luck.
Mario.

[TonyKoke]

From the 2 axis hole process, under the "Cut Control" tab..., in the "Cycle Type" box..., choose "Chip Break" and when you post, it will come out "long hand"

[CNCRim]

From the 2 axis hole process, under the "Cut Control" tab..., in the "Cycle Type" box..., choose "Chip Break" and when you post, it will come out "long hand"

Thanks you it work like I want it.