585,719 active members*
4,431 visitors online*
Register for free
Login
IndustryArena Forum > CAM Software > UG NX > Engraving Problem's
Results 1 to 13 of 13
  1. #1
    Join Date
    Sep 2007
    Posts
    126

    Engraving Problem's

    Being thing's are a little slow now, I thought I would try a little engraving with the text engraving-planer option in NX5. But when I try to select my geometry ( curves & splines ), I can't get it to select my geo. Only option's I see are , note's , label , & symbol . Is this option as it say's, "text" only or what am I doing wrong? The file is a logo I brought in with Adobe Illistrator & made it a "dxf " file . Thank's for any help in advance.




    Harold C.

  2. #2
    Join Date
    Feb 2006
    Posts
    146
    The Engraving operation works with a Note - like a note from drafting.

    If you want to cut lines and arcs then use planer mill and make ON boundaries. Set the cut pattern to Standard drive. Define the floor. You can use a negative floor stock or offset the floor into the part the depth of the "Engraving"
    John Joyce -NC Programming Supervisor
    Barnes Aerospace, Windsor CT

  3. #3
    Join Date
    Sep 2007
    Posts
    126

    Thank's

    :cheers: Kind of what I thought. I'll try method as you described.

    Harold C.

  4. #4
    Join Date
    Sep 2009
    Posts
    78
    Hi Harold,
    It's Jim again and I thought I'd hit this thread too!

    You can't engrave pictures in NX but you can engrave text quite nicely. Planar text is very straight forward and it's for engraving on flat surfaces and contour text is for 3-D surfaces.

    For engraving I like to use single stroke drafting fonts. Here is my work flow, step by step: Start the drafting application and create a sheet, toggle the Display Sheet button (now the graphics window should look like you are in modeling, even though drafting is still active), create a block of text as would usually do in drafting. Go back into manufacturing and make a planar or contour text operation. You can select this block of text for the operation to cut and the rest of the operation settings should be familiar to you. By the way, in NX6 the operation just asks for text to select; there is no left, right or on. I have only used single stroke fonts so I can't say for sure how it handles other situations.

    These engraving operations are really nice to use. I especially like the way you can specify multiple depth cuts and ramp engage moves. I can't remember the last time I snapped off an engraving tool. We use some 1/16" diameter balls but also use 1/32", 1/64" and sometimes use old-school 4-sided tools that range from .001"-.010" diameter with drafts ranging from 5 deg/s to 15 deg/s.

    As for engraving images, well, NX can't do that yet as far as I know. Some of the other CAM softwares can do it but I think it's a case of NX customers have not asked for it much. Siemens uses a customer involvement process to add features and make changes to the software. I am not saying that nobody has asked for image engraving, rather that there may not be enough users asking for it. I have used NX since Unigraphics v9 or 10 (It's been a while so I can't remember exactly! I guess I need to start taking Geritol, lol.) and they have been great for gathering user input for changing things.

    A little bit of trivia for those who may not be too familiar with NX legacy versions: NX1 would have been UG v19 so if we stayed with the old version convention NX would be at v24. (yeah, I'm a CAD/CAM geek!)
    NX 10.0.3

  5. #5
    Join Date
    Aug 2008
    Posts
    71
    Quote Originally Posted by weirdharold View Post
    Being thing's are a little slow now, I thought I would try a little engraving with the text engraving-planer option in NX5. But when I try to select my geometry ( curves & splines ), I can't get it to select my geo. Only option's I see are , note's , label , & symbol . Is this option as it say's, "text" only or what am I doing wrong? The file is a logo I brought in with Adobe Illistrator & made it a "dxf " file . Thank's for any help in advance.
    Harold C.
    As you haev seen, Text means drafting annotation only.

    If you have text modeled as geometry, try surface contouring with the point/curve drive method.

    Mark Rief
    Siemens PLM

  6. #6
    Join Date
    Jun 2010
    Posts
    0
    Engraving? Could you substitute axis to output for 4th axis like mastercam does

  7. #7
    Join Date
    Apr 2016
    Posts
    1

    Re: Engraving Problem's

    Quote Originally Posted by camster View Post
    The Engraving operation works with a Note - like a note from drafting.

    If you want to cut lines and arcs then use planer mill and make ON boundaries. Set the cut pattern to Standard drive. Define the floor. You can use a negative floor stock or offset the floor into the part the depth of the "Engraving"
    Worked with NX10. But i must do a click on "create new boundary" after every curve i selected. If i have 300 curves - its a huge annoing work. If i select group of curvers - operation makes trajectory for only one curve.

  8. #8
    Join Date
    Aug 2008
    Posts
    71

    Re: Engraving Problem's

    Quote Originally Posted by Boogrow View Post
    Worked with NX10. But i must do a click on "create new boundary" after every curve i selected. If i have 300 curves - its a huge annoing work. If i select group of curvers - operation makes trajectory for only one curve.
    Did you try curve/point drive in surface contouring? This will lift between each set. You may be able to select using an intent like connected curves, then MB2 to add each new set.
    Mark Rief
    Siemens PLM

  9. #9
    Join Date
    Aug 2007
    Posts
    21

    Re: Engraving Problem's

    Hi,

    I'm using a different and fast way to engrave any picture.
    I will upload any demo file but i do not now how to.
    NX 7.5 is at the moment the version in use.
    If You tell me how to upload, i will be glad to send this demo file on this forum.

  10. #10
    Join Date
    Sep 2009
    Posts
    78

    Re: Engraving Problem's

    Quote Originally Posted by maniso View Post
    Hi,
    I'm using a different and fast way to engrave any picture.
    I will upload any demo file but i do not now how to.
    NX 7.5 is at the moment the version in use.
    If You tell me how to upload, i will be glad to send this demo file on this forum.
    Sounds interesting! I look forward to seeing it.
    NX 10.0.3

  11. #11
    Join Date
    Aug 2007
    Posts
    21

    Re: Engraving Problem's

    This is the part for engraving.
    Try to see how it is done by looking to the manufacturing way.
    Hope You will figur it out.

    Regards

  12. #12
    Join Date
    Sep 2009
    Posts
    78

    Re: Engraving Problem's

    I looked at your part. I thought you had an automation journal or something special in it but this is a basic engraving example which we do frequently.

    Wow this thread won't die!
    NX 10.0.3

  13. #13
    Join Date
    Aug 2007
    Posts
    21

    Re: Engraving Problem's

    As You can see, i select with window and not every curve one at the time.
    This, acording to me, is a fast way to select any picture imported as DXF.
    The way the tool is running show it.
    There is no control to change this sequence.

Similar Threads

  1. Engraving problem
    By marko rihelj in forum Laser Engraving / Cutting Machine General Topics
    Replies: 11
    Last Post: 03-07-2014, 02:51 AM
  2. engraving problem
    By murphyc1 in forum GibbsCAM
    Replies: 3
    Last Post: 02-27-2014, 08:17 PM
  3. Chinese Laser Cutting and Engraving Machine TS-6040 60w - Engraving problem
    By Andriette in forum Laser Engraving / Cutting Machine General Topics
    Replies: 6
    Last Post: 01-24-2014, 03:44 PM
  4. Engraving Problem
    By g1r9a6d8y in forum Laser Engraving / Cutting Machine General Topics
    Replies: 25
    Last Post: 01-08-2011, 04:43 PM
  5. PROBLEM ENGRAVING
    By REM in forum Mastercam
    Replies: 4
    Last Post: 11-04-2010, 12:20 AM

Tags for this Thread

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •