603,855 active members*
3,826 visitors online*
Register for free
Login

Thread: URGENT.

Results 1 to 9 of 9
  1. #1
    Join Date
    Jun 2009
    Posts
    1

    URGENT.

    Hi all

    Am very new to CNC

    Programming a Supermax with Fanuc OT Control

    Trying to thread a Nut INTERNALLY

    tried using G76 but the Graphics Display shows it still cutting EXTERNAL thread
    WHY?????????????????????????/
    x91.6
    z1.0 M08
    G76 P011060 Q030
    G76 X91.6 Z-11.0 P4580 Q030 F1.5875 (16 TPI )

    WHY is this not working

  2. #2
    Join Date
    Mar 2004
    Posts
    1527
    On my machine, ID vs. OD is determined by the X position being smaller than the G76 X. And this X position also determines the pullout position at the end of each cutting pass so you have to choose this value carefully. In short, try changing your X91.6 to something smaller.

    Karl

  3. #3
    Join Date
    Mar 2003
    Posts
    2932
    tried using G76 but the Graphics Display shows it still cutting EXTERNAL thread
    WHY?????????????????????????/
    x91.6 <--- must be less than major diameter - 2* height of thread
    z1.0 M08
    G76 P011060 Q030
    G76 X91.6 (major) Z-11.0 P4580 (height) Q030 F1.5875 (16 TPI )

    Also, your P value seems to be incorrect. Are you specifying 4.58mm (0.180) or 0.458mm (0.018)? Neither sounds right for 16 TPI)

  4. #4
    Join Date
    May 2007
    Posts
    1003
    What is the thread size call out on the drawing?

  5. #5
    Join Date
    May 2009
    Posts
    104

    Threads

    Your P value for a 16 tpi ID thread should be P3380.
    Your X start point should be smaller than your X value in the G76 line for an ID thread.
    Good luck.

  6. #6
    Join Date
    Mar 2003
    Posts
    2932
    maz43: It appears as if he's programming in millimeters. I believe your P3380 is 0.0338 inches, correct?

  7. #7
    Join Date
    May 2007
    Posts
    1003
    Appears it isn't too "URGENT" after all.

    Mr. Coupar, my Hardinge manual says the format for P and Q is Q4 P4 for inch and Q3 P3 for metric. We know this means P3380 is .3380 for inches. What I don't know is how the control handles an extra digit. Does in simply ignore the left most digit in P3380 making it .380 for metric? The machine manual doesn't say. The Fanuc operator's manual I looked at doesn't even mention the number of digits allowed in the address.

    What I can tell the original poster is that the machine appears to be threading an OD thread because his P-value is too large. Plus his start position accentuates the problem. We use to have a Hardinge Super Precision (now at a sister company). P3500 is .03500 with it, but when the program runs on a standard Hardinge it becomes .3500 and it acts like the OP is describing.

  8. #8
    Join Date
    Mar 2003
    Posts
    2932
    g-codeguy: I believe P can have 8 digits. So P12345678 would be 1234.5678 inches, or 12345.678 millimeters. And I don't think it ignores any digits. The way I read it, P3380 is .3380 inches or 3.380 millimeters. But you're right that it doesn't appear to be URGENT anymore.

  9. #9
    Join Date
    May 2007
    Posts
    1003
    Quote Originally Posted by dcoupar View Post
    g-codeguy: I believe P can have 8 digits. So P12345678 would be 1234.5678 inches, or 12345.678 millimeters. And I don't think it ignores any digits. The way I read it, P3380 is .3380 inches or 3.380 millimeters. But you're right that it doesn't appear to be URGENT anymore.
    You are most likely correct. That is why his ID thread appears to be an OD thread. .1803 inch is a bit much for thread height on a 16 pitch thread. The tool is going to drop down a fair amount to start its threading cycle. Especially since his approach and ending thread dimensions are the same. Wouldn't be quite so bad if the approach was where it should be.

Similar Threads

  1. urgent need !
    By y.y in forum Stepper Motors / Drives
    Replies: 1
    Last Post: 09-27-2008, 09:59 PM
  2. I need urgent help
    By Bezgin in forum Laser Engraving / Cutting Machine General Topics
    Replies: 1
    Last Post: 09-29-2007, 02:49 AM
  3. Urgent Help Needed!
    By tmole in forum Bridgeport / Hardinge Mills
    Replies: 2
    Last Post: 02-23-2007, 02:04 PM
  4. URGENT: 2J Quill return sping replacement -URGENT
    By NC Cams in forum Bridgeport / Hardinge Mills
    Replies: 8
    Last Post: 02-14-2006, 05:48 AM

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •