[JerryFlyGuy]

Sorry guys I edited Brian's post by accident... I think it's back to it's original form.

FWIW, machining these parts would not require drawing them just to get the G code. This is something which is easily programable just by hand writing the code. You need a 4 axis machine to machine the parts but you would regardless [whether you draw it and then use a CAM or just hand code it]

You'll need a tool which is ground to the shape of the tooth before you start, as well as the machining equipment.

The code in it's basic form is
F[set feed speed] S[set spindle speed]
G0 x0 y0 z [some dim larger than the major diameter]
G1 z [to minor diam of tooth]
x [width of tooth--this is the part that actually cuts the tooth]
G0 z [ move back up to clearance height ]
X0 A [360/# of teeth]

Repeat this times the # of teeth.

Voila..
J

[pixburghenat]

Jerry,

The only thing different is the attached image.
Here's the same thing in another post.
http://www.cnczone.com/forums/showthread.php?t=57313

The ratchet is only a sample of what a gear looks like.
The numbers don't work out for the ratchet.


Brian,
For your gear, you will need a custom made V cutter, as said.
Yes, you can cut this on a vertical mill, manual or CNC.
Indexer or 4th Axis needed, also stated.

There are many ways to model your gear.
Are you using Solidworks? Are you a student?
I only ask because your others posts seem to indicate you are working on a project making gun parts.

pix

[brianklein]

I'm not very knowledgeable in solidworks, though i do have solidworks 2007 on my computer. I'm just trying to make a ratchet like the one in the pictures i posted.

[brianklein]

"FWIW, machining these parts would not require drawing them just to get the G code. This is something which is easily programable just by hand writing the code. You need a 4 axis machine to machine the parts but you would regardless [whether you draw it and then use a CAM or just hand code it]

You'll need a tool which is ground to the shape of the tooth before you start, as well as the machining equipment.

The code in it's basic form is
F[set feed speed] S[set spindle speed]
G0 x0 y0 z [some dim larger than the major diameter]
G1 z [to minor diam of tooth]
x [width of tooth--this is the part that actually cuts the tooth]
G0 z [ move back up to clearance height ]
X0 A [360/# of teeth]

Repeat this times the # of teeth."

Thank you.

[pixburghenat]

"FWIW, machining these parts would not require drawing them just to get the G code. This is something which is easily programable just by hand writing the code. You need a 4 axis machine to machine the parts but you would regardless [whether you draw it and then use a CAM or just hand code it]

You'll need a tool which is ground to the shape of the tooth before you start, as well as the machining equipment.

The code in it's basic form is
F[set feed speed] S[set spindle speed]
G0 x0 y0 z [some dim larger than the major diameter]
G1 z [to minor diam of tooth]
x [width of tooth--this is the part that actually cuts the tooth]
G0 z [ move back up to clearance height ]
X0 A [360/# of teeth]

Repeat this times the # of teeth."

Thank you.

Your diameter will really be 1.3724"

The included angle of your form cutter will be 76.35 degrees

Can be cut with a common 45 or 60 degree dovetail cutter, manual or CNC.

enat

[brianklein]

Thanks for the diagram

"Your diameter will really be 1.3724"

The included angle of your form cutter will be 76.35 degrees

Can be cut with a common 45 or 60 degree dovetail cutter, manual or CNC."

How did you determine that the form cutter angle would have to be 76.35 degrees??? How can you get a 45 or 60 degree dovetail cutter to cut an angle 76.35 degrees??? And the total diameter (from tooth tip to opposite tooth tip) for the gear is 1.375" so how did you get 1.3724" for the diameter??? Thanks for your help.

[pixburghenat]

Thanks for the diagram

"Your diameter will really be 1.3724"

The included angle of your form cutter will be 76.35 degrees

Can be cut with a common 45 or 60 degree dovetail cutter, manual or CNC."

How did you determine that the form cutter angle would have to be 76.35 degrees??? How can you get a 45 or 60 degree dovetail cutter to cut an angle 76.35 degrees??? And the total diameter (from tooth tip to opposite tooth tip) for the gear is 1.375" so how did you get 1.3724" for the diameter??? Thanks for your help.

Brian,

I used your supplied data. I said in an earlier post your numbers don't work out precisely. I drew the model with your numbers and used Bamber's decription for sketching. Only I made a cut with the first V, then used a pattern feature to finish the full 360 degrees. With your numbers there is an overlap at the diameter, hence the slightly smaller diameter. I didn't include it, but the .050 lengths are a bit shorter too because of the overlap. This is due to using the 1.295 root number and the lengths of the V.

What does work out better is an angle of 74 degrees, this will give you the 1.375 diameter, with a small crest width of .0006, and the 1.295 root, but the flats will be .0493. By simply rounding the .0493 to .050, it changes everything.

Gear data usaually uses the pitch circle or diameter, where the gears engage, and a specific tooth form. The root and gear diameter will be nominal.

This is why I asked if you were a student, sometimes instructors will introduce a problem with nominal data to see how the student solves the problem.

As for the V tool. Yes you could have one made or grind one yourself and it might work okay in soft materials. But chances are the tip will break off while cutting unless you can get enough RPMs on it, like 10K+.

So I thought, if I had to make this today what would I use. And this is where the model really helps you, even a paper sketch. Look at the sketch, you can cut this off axis using a dovetail cutter.

In Solidworks I modeled the cutter, don't merge, and constrained it to the gear. This gave me the XYZA data using the face on the cutter. Then do the same thing and use the angle side of the cutter with the new XYZA data
and take the next pass.

Scott