[frogier]

I am trying to hone out a hole with a flex hone. Is there a macro or looping program to do this instead of repeating the x,y position over and over again?

Ex.

G0 G90 G54 X0 Y0 M3 S850
G43 Z.1 H1 M8
G85 X0 Y0 R.1 F300.
X0 Y0
X0 Y0
X0 Y0
X0 Y0
X0 Y0
AND SO ON AND SO ON
G80 Z.1 M9

any help would be appreciated.

[beege]

Maybe put it in a sub and call from the main program:

G0 G90 G54 X0 Y0 M3 S850
G43 Z.1 H1 M8

M98P1000L100

and your sub....

O1000
G85X0Y0R.1 (what about z?) F300.
M99

[psychomill]

What control is this? Some controls will accept a repeat command with the canned cycle such as an "L"...

G85 X0 Y0 Z-?? R.1 F300. L20


.... Or even a "K" ...

[frogier]

They are fanuc controls on Mori VMC. The depth is 1"

[stevo1]

What model Fanuc control are you using?

There is a few different ways that you could do it. As Beege and Psyco have already suggested you can do a subprogram with the L value to repeat the sub for the amount of holes that you want. One thing is you have to have a same or common distance between the holes, like 1” apart.

You can also use macroB if that option is on your control. There would be no need to have a subprogram. This can be done a few ways using the “IF” or “WHILE” statement. If you are going to be running parts were the number of holes changes or the distance between the holes changes then you can setup variables so you can change them easily per part. I need to know the common X()Y() values of each location. The example below will do 10 holes across in X spaced 1” apart. If you need to add the Y() distances it will have to be changed but it will give you the general idea.


#1=10(NUMBER OF HOLES)
#2=1(DISTANCE BETWEEN HOLES)
#3=0(COUNTER)
G0 G90 G54 X0 Y0 M3 S850
G43 Z.1 H1 M8
WHILE[#3LE#1]DO1
G85 X#3 Y0 R.1 Z-1.0 F300.
#3=#3+#2
END1
G80 Z.1 M9

Stevo