[MysticMonkey]

Your home made macro works then, did the manuals help ?

dung_ninhbinh

Contact your local Doosan CNC dept,
DOOSAN MECATEC Co Ltd.
DOOSAN VINA (CPE PLANT)
DUNG QUAT ECONOMIC ZONE
BINH THUAN BIN SON
QUANGNGAI PROVINCE, VIETNAM

TEL: 84 553 618 900
FAX: 84 553 618 955


They need to know
1. Machine Model number
2. Machine Serial number
3. Control Model

Tell them that you have lost all 9000 macros and please help to get new ones

[dcoupar]

Mystic,

Now I'm confused. I thought dung_ninhbinh had an Anderson router and FrankCNC had a Daewoo ACE H-100. Did I miss something?

Dave

[dung_ninhbinh]

thank you mystic, frank, docp.
I test to write and the machine operation with #1000 on A table. I dont know which number for B table.
#1100=1;
N1 IF[#1000 EQ 1] GOTO99;
GOTO1;
N99 M99;
now i am working with M98 and M00 on the first line of program.
My machine number: FAANCPT92077
Fanuc 18-M (Anderson router)
The machine have two spindle, and one saw.
anyone have idea please post here, i dont want to call service... hihihi
When finished this problem, i will post full O9001
Thank you everyone,
Regard
Nguyen

[FrankCNC]

My apologies for the confusion, Nguyen stated in an earlier post that his tool changer works OK so the problem must be elsewhere, from another post Nguyen stated

'M100 and M101 use to call subprogram. That code on the top of program. When use it, it wait we push OK button on the table then machine will run.'

From this I thought M100 might call a subprogram that checks which table is setup and ready to machine on his Anderson when he pushes the OK BUTTON ON THE TABLE.

I was just giving an example of how the ACE-H100 knows when the next pallet is ready to be machined that might give Nguyen an idea on the subprogram that MIGHT need to be written using user inputs to check when a button is active for the M100 call.

[MysticMonkey]

Mystic,

Now I'm confused. I thought dung_ninhbinh had an Anderson router and FrankCNC had a Daewoo ACE H-100. Did I miss something?

Dave

Sorry, I skim read the beginning of the post. My Bad

[dung_ninhbinh]

I wrote macro program
O9001 (Macro for change pallet);
G91 G28 Z0;
G90 G49 H0;
G81 G0 X#502;
#1100 =1;
N1 IF[#1000 EQ 1] GOTO99;
IF[#1001 EQ 1] GOTO100;
GOTO1
N99 M99;
N100 M99;
It operation very well for two tables, #1000 for Y table and #1001 for V table
Parameter 6071 i write 100,
Main program follow:
O8000 (MAIN PROGRAM);
M100;
IF[#1101 EQ 1] GOTO1000;
M98 P0456;
M99;
N1000;
M98 P0457;
M99;

O0456 (SUB PROGRAM FOR Y TABLE)
O0457 (SUB PROGRAM FOR V TABLE)
That for Fanuc 18M
Thank you for your help.
Regard,

[dung_ninhbinh]

Hi FrankCNC,
Thank you for your help,
I wrote program from your information, i post here
That is Macro to change table for Fanuc 18M
%
O9001
IF[#1003 NE 1] GOTO100
N5 IF[#1000 EQ 1]GOTO10
IF[#1001 EQ 1] GOTO10
IF[#1101 EQ 0] GOTO5
G91 G09 G00 Z[0-#5023]
G91 G09 G00 X[#501-#5021]
G04 P300
GOTO5
N10 G91 G17 X0 Y0
M50
#1101=1
#1102=0
M60
M99
N100 IF[#1000 EQ 1] GOTO120
IF[#1001 EQ 1] GOTO130
IF[#1101 EQ 0] GOTO100
IF[#1102 EQ 1] GOTO110
G91 G09 G00 Z[0-#5023]
G91 G09 G00 X[#501-#5021]
G04 P300
GOTO100
N110 G91 G09 G00 Z[0-#5023]
G91 G09 G00 X[#502-#5021]
G04 P300
GOTO100
N120 G91 G17 X0 Y0
M50
#1101=1
#1102=0
M99
N130 G91 G17 X0 V0
M60
#1101=1
#1102=1
M99
%

[FrankCNC]

Hi Nguyen,

Good to hear you've been successful, I'm surprised that the User Inputs for the Daewoo are the same as the Anderson, I would have thought they would have been machine specific. I only listed them as a guide to show what to look for in you Anderson literature and machine.

I worked out the Pallet User Inputs for our machine by going into CNC/PMC then PCDGN then searching for UI31.G to bring up the User Input screen then seeing which User Inputs changed from 0 to 1 or 1 to 0 when I changed the pallets on the machine.

Regards,
Frank.