[edufer1]

Hi!!

For example a tap is broken in hole number 4 so I want to restart in hole number 5.................mi programs don't have number blocks only in each tools have a label like this "NAT14" (this means T14 in table A) also have jump / condition, etc, etc, and never read M02 (GOTO NSTART)......it's a program to machinig similar parts...

-----------
NAT23 T23 M06(*T23* MACHO M10x1,5)
(10 ROSCADOS *B0*)
G15 H1
G00 G56 X126.34 Y-39.93 Z300 B0 H=VATOL S500 M03
(GAS REF 910 LLAMA A *T66*)
(GAS REF 520 LLAMA A *T46*)
(GAS REF 297 LLAMA A *T46*)
(GAS REF 452 LLAMA A *T46*)
(DIESEL REF 475 LLAMA A *T01*)
IF[VC1 EQ 910]NLLT66
IF[VC1 EQ 520]NLLT46
IF[VC1 EQ 297]NLLT46
IF[VC1 EQ 452]NLLT46
IF[VC1 EQ 475]NLLT01
NLLT66
T66
GOTO NCONT
NLLT46
T46
GOTO NCONT
NLLT01
T01
NCONT
M08
M51(TALADRINA ALTA PRESION)
G284 Z-23 R2 F750 M54
X86.86 Y-99.57
X55.72 Y-61.17
X-103.5 Y-70
X-111.36 Y-36.44 -----------------------restart here
X-71.97 Y-29.49
X-125.45 Y43.45
X-151 Y73
X-86.06 Y50.39
X-11.03 Y82.01
G00 Z800 M09
M05
M339(SOPLADO HUSILLO)
G04 F3

If I renumber all the program it's possible a solutions with Key RESTART?..............I don't now........

Regards.

[littlerob]

Someone will correct me if I'm wrong cause I haven't run a U-10, but I don't think there is that much discrepancy. You will be able to use the restart function on a sequence number, you can find the correct sequence number by running the program in graphics with the machine locked, or just make a z offset and "dryrun" it. Find the sequence number and use the sequnce restart function just like normal. If you single block it through you will see the sequence number progress on the screen

[Algirdas]

sequence number or name, the label, generally saying, is just for easy search. Sure, it's better, if you have more lines labeled. It's possible to do on Okuma lathe, or using PC. Machining centers don't have automatic sequence numbering by deefault.
I would suggest to read the manual chapter about sequence restart carefully, it makes point.
Sure, you can start the part program from any line - just where cursor is pointing to. You don't need sequences to be numbered then.
The procedure of sequence restart is:
1. Single block mode.
2. Reset, make sure necessary program is selected for execution. It's good to list all program in automatic mode screen, to make sure, it is fulle read to memory already.
3. search for desired sequence number (oft key "search" with sequence number)
4. restart to desired sequence number (soft key "restart" with sequence number). OSP will simulate execution of part program quickly without mechannical movement. Cursor runs from start of the program to sequence of restart
5. restart by machine control button "restart"
I'm not sure whether and when green button to press. First steps in single step mode, next you can switch single block off and then green button to rn normally.

[edufer1]

sequence number or name, the label, generally saying, is just for easy search. Sure, it's better, if you have more lines labeled. It's possible to do on Okuma lathe, or using PC. Machining centers don't have automatic sequence numbering by deefault.
I would suggest to read the manual chapter about sequence restart carefully, it makes point.
Sure, you can start the part program from any line - just where cursor is pointing to. You don't need sequences to be numbered then.
The procedure of sequence restart is:
1. Single block mode.
2. Reset, make sure necessary program is selected for execution. It's good to list all program in automatic mode screen, to make sure, it is fulle read to memory already.
3. search for desired sequence number (oft key "search" with sequence number)
4. restart to desired sequence number (soft key "restart" with sequence number). OSP will simulate execution of part program quickly without mechannical movement. Cursor runs from start of the program to sequence of restart
5. restart by machine control button "restart"
I'm not sure whether and when green button to press. First steps in single step mode, next you can switch single block off and then green button to rn normally.

Hi Algirdas,

Thanks for your replay,

in step 3 and 4 you put it with sequence number,

but my question was if is possible wihtout sequence number...............so if there are NO solutions without sequence number I try it renumber all the program.

Regards.

[edufer1]

Hi!!

For example a tap is broken in hole number 4 so I want to restart in hole number 5.................mi programs don't have number blocks only in each tools have a label like this "NAT14" (this means T14 in table A) also have jump / condition, etc, etc, and never read M02 (GOTO NSTART)......it's a program to machinig similar parts...

-----------
NAT23 T23 M06(*T23* MACHO M10x1,5)
(10 ROSCADOS *B0*)
G15 H1 ----------------------------------------------------#01
G00 G56 X126.34 Y-39.93 Z300 B0 H=VATOL S500 M03 ------#02
(GAS REF 910 LLAMA A *T66*)
(GAS REF 520 LLAMA A *T46*)
(GAS REF 297 LLAMA A *T46*)
(GAS REF 452 LLAMA A *T46*)
(DIESEL REF 475 LLAMA A *T01*)
IF[VC1 EQ 910]NLLT66
IF[VC1 EQ 520]NLLT46
IF[VC1 EQ 297]NLLT46
IF[VC1 EQ 452]NLLT46
IF[VC1 EQ 475]NLLT01
NLLT66
T66
GOTO NCONT
NLLT46
T46
GOTO NCONT
NLLT01
T01
NCONT
M08 -------------------------------------------------------#03
M51(TALADRINA ALTA PRESION)-----------------------------#04
G284 Z-23 R2 F750 M54 ------------------------------------#06
X86.86 Y-99.57
X55.72 Y-61.17
X-103.5 Y-70
X-111.36 Y-36.44 -----------------------restart here----#05
X-71.97 Y-29.49 ---------------------------------------#07
X-125.45 Y43.45
X-151 Y73
X-86.06 Y50.39
X-11.03 Y82.01
G00 Z800 M09
M05
M339(SOPLADO HUSILLO)
G04 F3

If I renumber all the program it's possible a solutions with Key RESTART?..............I don't now........

Regards.

Hi!!

I find the solution.................is easy but dangerous.

initial condition: tool in spindle (or search in M06)
one block active.

Search with the cursor the beginning the tool (in my example mark #01)
Twice Cycle start. (read #01/#02)
Move cursor to #03
Twice Cycle start. (read coolant #03/#04)
Atention: Move the cursor to #05
Once Cycle Start. (the machine move to hole number 5)
Atention: Move the cursor to #06
Once Cycle Start. (load cycle parameters)
Twice cycle start. (machining the hole)
Atention: Move the cursor to #07
One block is off
Cycle Start. (the machining continous with the program)

Thanks.

[Superman]

Why not just put a sequence # on the line you what to continue the run from ( restart at )
activate the program

Then do a number search to start on the line after the toolchange, then do a sequence restart on the number you just inserted into the program

[edufer1]

Why not just put a sequence # on the line you what to continue the run from ( restart at )
activate the program

Then do a number search to start on the line after the toolchange, then do a sequence restart on the number you just inserted into the program

It's Ok.

But from my point of view is better no editing the program by the operators, because not all the operators have the knowledge.

Also after restart operations must be deleted the label (to keep a good program...............syntax order)

Regards.

[Superman]

But from my point of view is better no editing the program by the operators, because not all the operators have the knowledge..

Understood, keep the roaming fingers out

Also after restart operations must be deleted the label (to keep a good program...............syntax order)

Why not have every line numbered, and be done with it ?
N# for all lines
NAT(tool#) at toolchange lines

if there is an issue with a program, they say what line #, you both know exactly what line you are talking about.

[edufer1]

Why not have every line numbered, and be done with it ?
N# for all lines
NAT(tool#) at toolchange lines

if there is an issue with a program, they say what line #, you both know exactly what line you are talking about.

Ok, Superman

You are right.

In Siemens I number all the programs from N10 to N....

But in Fanuc (Mori-Seiki) and Okuma only the tool change and conditional blocks

..........................habit.......obsessions.. .......


Thanks.

[ad64075]

Why cannot you do a restart by block number instead of sequence number? Same principle using restart, but instead of specifying an "N" number, use your block number. No need to alter the program at all to do this.

[littlerob]

Why cannot you do a restart by block number instead of sequence number? Same principle using restart, but instead of specifying an "N" number, use your block number. No need to alter the program at all to do this.

Right, never even thought of that.

[Superman]

The only time this method is an issue is :-

if you are running the pogram continuously as you would use a bar-feed ( the program jumps back to the program start before actually reaching the program end M2 or M30 )

Bit hard to restart on the 150th cycle

Then the sequence restart is the quicker option

[littlerob]

Am I missing something? Are we drowning this thread, and posting in circles? I must've misread a post along the way or something. :drowning:

Robert