[jcowie]

Hi - I am a beginner so the answer to this is probably very easy!

I am loading G-code from a pc to a very old Fanuc O-M controller working with a Denford Milling M/c. I use CIMCO edit comms software.

I enter o7000 and read. The LSK blinks so its waiting for the pc to send. With the G-code in the CIMCO window I edit the name of the program to o7000 on the second line of code and click the send button on the DNC toolbar.

Half the program is loaded as o7000 and the rest is loaded as o7001.

Anyone know what is causing this?

cheers - John

[cnc2149]

It sounds like your Series 0 control has parameter 19 bit 6 = 1. This will recognize each occurrence of M02, M30 and M99 as the end of a part program. The next block read will be the first block of a new part program.

Set parameter 19 bit 6 = 0 to disable this operation.

Since you are new to this CNC, the bit numbering is 7 on the far left and 0 on the far right. Record all 8 bits of parameter 19 on paper before you attempt to change anything. You have to be in MDI or ESTOP, set Parameter Write Enable = 1, type in ALL of the bits in parameter 19 (not just the status of bit 6) and press INPUT.

[angelw]

Hi - I am a beginner so the answer to this is probably very easy!

I am loading G-code from a pc to a very old Fanuc O-M controller working with a Denford Milling M/c. I use CIMCO edit comms software.

I enter o7000 and read. The LSK blinks so its waiting for the pc to send. With the G-code in the CIMCO window I edit the name of the program to o7000 on the second line of code and click the send button on the DNC toolbar.

Half the program is loaded as o7000 and the rest is loaded as o7001.

Anyone know what is causing this?

cheers - John

What cnc2149 wrote is so, but before you go to far with changing parameters, check that you haven't inadvertently typed an "O" character instead of a Zero. Fanuc controls will read this as another program and if a number is not specified it will increment to the next number. Typing "O"s instead of Zeros is a common trap for new players.

Regards,

Bill