[dbills]

can anyone please send me a program format for a Cincinnati arrow with a Siemens acromat 2100 control. i am a fanuc haas programmer and am not familiar with some of the work offset and tool calls.

thanks

[ktmktmman]

Here is a program we run in a Arrow 500 with the Siemens A2100 control. Ask any questions!


: T1 M6
(MSG,600-20 Nose Cone)
N002(MSG,.990 Mini Mill)
N003 G90 G0 X-1.12 Y-1.1556 S1929 M3 H1
N004 Z.1 M27
N005 G1 Z-.1875 F50.
N006 G41 Y-.7806 F23.148
N007 Y.7806
N008 G40 Y1.0306
N009 G0 Z1.
N010 X-1.12 Y-1.1556
N011 Z-.0875
N012 G1 Z-.375 F50.
N013 G41 Y-.7806 F23.148
N014 Y.7806
N015 G40 Y1.0306
N016 G0 Z1.
N017 X1.12 Y1.1556
N018 Z.1
N019 G1 Z-.1875 F50.
N020 G41 Y.7806 F23.148
N021 Y-.7806
N022 G40 Y-1.0306
N023 G0 Z1.
N024 X1.12 Y1.1556
N025 Z-.0875
N026 G1 Z-.375 F50.
N027 G41 Y.7806 F23.148
N028 Y-.7806
N029 G40 Y-1.0306
N030 G0 Z1.
N031 X-1.12 Y-1.1556 H2
N032 Z.1
N033 G1 Z-.1875 F50.
N034 G41 Y-.7806 F23.148
N035 Y.7806
N036 G40 Y1.0306
N037 G0 Z1.
N038 X-1.12 Y-1.1556
N039 Z-.0875
N040 G1 Z-.375 F50.
N041 G41 Y-.7806 F23.148
N042 Y.7806
N043 G40 Y1.0306
N044 G0 Z1.
N045 X1.12 Y1.1556
N046 Z.1
N047 G1 Z-.1875 F50.
N048 G41 Y.7806 F23.148
N049 Y-.7806
N050 G40 Y-1.0306
N051 G0 Z1.
N052 X1.12 Y1.1556
N053 Z-.0875
N054 G1 Z-.375 F50.
N055 G41 Y.7806 F23.148
N056 Y-.7806
N057 G40 Y-1.0306
N058 G0 Z1. M9
: T2 M6
N059(MSG,3/4 EM)
N060 G0 X-1. Y-1.1556 S1782 M3 H1
N061 Z.1 M8
N062 G1 Z-.375 F50.
N063 G41 Y-.7806 F21.384
N064 Y.7806
N065 G40 Y1.0306
N066 G0 Z1.
N067 X1. Y1.1556
N068 Z.1
N069 G1 Z-.375 F50.
N070 G41 Y.7806 F21.384
N071 Y-.7806
N072 G40 Y-1.0306
N073 G0 Z1.
N074 X-1. Y-1.1556 H2
N075 Z.1
N076 G1 Z-.375 F50.
N077 G41 Y-.7806 F21.384
N078 Y.7806
N079 G40 Y1.0306
N080 G0 Z1.
N081 X1. Y1.1556
N082 Z.1
N083 G1 Z-.375 F50.
N084 G41 Y.7806 F21.384
N085 Y-.7806
N086 G40 Y-1.0306
N087 G0 Z1. M9
N088 G98 X20. Y30. M5
N089 M2

[dbills]

are block numbers mandatory? when putting readable notes in do you have to use "msg," in the parenthesis? thanks

[ktmktmman]

You don't have to have block numbers its just a personal preference. As for the message blocks i believe there is two ways.

1st way:
(MSG,insert message here)

2nd way:
;insert message here

The reason i use the first one is because it is very handy and that's how my cam software post out. Its handy b/c if you look at your cnc controller right above where the program is begin executed the is a spot that says MSG: so whatever the last MSG block the cnc executed it will show up there. Works good for long programs if you have those MSG blocks tell you what the machine is doing like this example:

:T1 M6
(MSG, 1" ENDMILL)
(MSG, ROUGH LARGE POCKET)
-----INSERT G CODE-----

As for the 2nd way i have never used it but i do remember reading about it in the programming manual.

[dbills]

thanks alot i appreciate it. i think i understand enough to put the code into the machine. are you familiar with the Siemens control? i may have some questions once i get to setting the machine up. i read the manual on setting tool lengths and work offsets and was a little confused we'll see what happens in a few days.

[ktmktmman]

yep we have 7 machines with the Siemens A2100 control. 3 VMCs, 3 Lathes, 1 Horzontal Mill. We really like the Siemens powered machines. So ask any questions!

[Strange179]

You might want to take special note of the tool change blocks in the program that ktmktmman posted. You'll notice they start with a colon. This is referred to as either a "sync block" or a "reference rewind stop." These are used in place of a regular line number for the line. You need to have one as the first block in the program and as my programming manual says "may be programmed at any additional point where it is desirable to establish a potential restarting point."

This information is for/from an Acramatic 950MC but it appears to be the same for the 2100.

Good Luck,
Jay

[underdog]

Hi. Thanks for posting the 2100 code.

Are H1 and H2 work offsets?
What is M27?
Are the tool length and diameter offsets all invoked just by the T1 command?

Could you look at and answer my questions under the TREE forum about setting up tool and work offsets in the TPC-2100, please?

Thanks,

[Axon-precision]

I just got A Cincinnati Falcon 300 with Siemens A2100 control.Could you please post a program sample for this machine?
Thanks,