[nick1236]

Hello everyone!

Long time lurker first time poster. I have been using Surfcam for about 6 years now. The posts my company used were never truly correct and they always hand edited them. I've taken it on my self to fix this once and for all. I've managed to edit several posts successfully but one is still throwing me for a loop. What i'm looking for is the structure format Mpost uses. I now all the command, sequences and variables. I just dont understand the structure it decides to output code.

For example:

here is my Mori post form:

name MORI LATHE


% 00
O 4
N >3
G >2
X ->3.>4
Z ->3.>4
D >2
I ->3.>4
K ->3.>4
p >4 P
q >4 Q
d ->3.>4
U ->3.>4
W ->3.>4
P ->3.>4
Q ->3.>4
R ->3.>4
F >3.>3
A 2
T >2
S >4
M >2
u 2

ModalLetters X Z I K F S M

ModalGs 0 1 2 3 80 81 82 83 84 85

Sequence#s N 0 1 10 10 100
First#? N
Last#? N


HCode Z
VCode X
FeedCode F

Comment ( )

Spindle 3 4 5
Coolant 8 9 7
SpeedType G 97 96
Dcomp 41 42 40

Feed G1
Rapid G0
Cw G2
Ccw G3

Sbackdoor Supressheader

Inc/Abs G 91 90

Inch/MM 20 21

CtrCode R

Leading0s? N

ByDiameter? Y
RevSigns
Spaces? Y

Incremental? N
CtrIncremental? Y
ByQuadrants? Y
ReturnPlane 98 99

UppercaseComments? Y

Tap
G77 Z[H] K[Vclear] F[FRate]
End

Ream
G74 Z[H] K[Vclear] F[FRate]
End

Bore
G74 Z[H] K[Vclear] F[FRate]
End

AutoThread
G33 X[V] Z[H] F[Frate]
End

Rough
if [TipAng] = -90
G72 p[StartN] q[EndN] d[Step] U[VLeave] W[SLeave] F[plunge]
else
G71 p[StartN] q[EndN] d[Step] U[VLeave] W[SLeave] F[Plunge]
endif
End

Finish
G70 p[StartN] q[EndN]
End

Cancel
G80
End

Upon [Speed]
M[Direct] S[Speed]
End

StartCode
%0
O0
End

1stToolChange
G18
"G0 G28 V0."
"G0 G53 X0. Z-15."
G50 G99 S[MaxRpm]
G[Work]
G0 T[Tool]
G[Work] G99 G18
M69
M46
G[SpeedType] S[Speed] M[Direct]
G0 X[V] Z.1 M[COOL]
Z[H]
End

Infeed
G0 X[V]
G1 G[Side] Z[H] F[FRate]
End

Outfeed
G1 X[V]
G1 G40 Z[H] F[FRate]
End

ToolChange
G0 Z.3 M[coolantoff]
"G28 V0."
"G53 X0. Z-15."
M5
M01
G0 T[tool]
G[Work] G99 G18
M69
M46
G[SpeedType] S[Speed] M[Direct]
G0 X[V] Z.1 M[COOL]
End

EndCode
G0 Z.3 M[coolantoff]
"G28 V0."
"G53 X0. Z-15."
M5
M30
%0
End

Replace "C0" with "C0."
Replace "T1" with "T0101"
Replace "T2" with "T202"
Replace "T3" with "T303"
Replace "T4" with "T404"
Replace "T5" with "T505"
Replace "T6" with "T606"
Replace "T7" with "T707"
Replace "T8" with "T808"
Replace "T9" with "T909"
Replace "T10" with "T1010"



To me it looks like my postform is correct but the output is still not correct.

Below is a very basic turning canned cycle operation:

%
O0000
G18
G0 G28 V0.
G0 G53 X0. Z-15.
G50 G99 S3000
G54
G0 T01010
G54 G99 G18
M69
M46
G96 S600 M3
G0 X1.2532 Z.1 M8
Z.0131


G0 X1.0674 (what controls this line)


G71 P100 Q110 D.1 U.01 W.003 F.012
N100 G0 X0
G1 G42 Z0 F.006
G1 X.35
G3 X.45 Z-.05 R.05
G1 Z-.2451
G2 X.55 Z-.2951 R.05
G1 X.6826
G3 X.7826 Z-.3451 R.05
G1 Z-.4886
G2 X.8826 Z-.5386 R.05
G1 X.9
G3 X1. Z-.5886 R.05
G1 Z-1.
X1.25
N110


G0 X1.0674
Z.0131 (where does this come from)


G70 P100 (missing the Q110)

G1 X1.25
G40 Z-.9984 F.006 (This looks like my Outfeed sequence, but why is it way down here?

G0 Z.3 M9
G28 V0.
G53 X0. Z-15.
M5
M30
%

I can't figure out where the phantom lines of code are coming from and how to change it. I'm hoping someone here can help me.

Thanks
-Nick

[nick1236]

I also just noticed that my tool numbers aren't coming out correct either....

T010101 should be T1010

Replace "T1" with "T0101"
Replace "T10" with "T1010"

T[tool] should be outputing T10 which would be replaced with T1010 right?

[nick1236]

Nevermind I think I figured it out. I found out how to have surfcam post the LOG file. It shows you all the CL data and what it coverted it too. I should be able to figure this out.

[Billetgrip]

You could shorten those replace commands by adding t >2 to your letter addresses, then change your tool change line to T[Tool] t[Tool] , after that you only need 1 replace line Replace " t" with "" . This also wouldn't hard code limit you to 10 tools.

[nick1236]

You could shorten those replace commands by adding t >2 to your letter addresses, then change your tool change line to T[Tool] t[Tool] , after that you only need 1 replace line Replace " t" with "" . This also wouldn't hard code limit you to 10 tools.

Awesome! thats one fix down, thank you.


Now about my other problems. here are the lines in question:

%
O0000
G18
G0 G28 V0.
G0 G53 X0. Z-15.
G50 G99 S3000
G54
G0 T1010
G54 G99 G18
M69
M46
G96 S600 M3
G0 X1.45 Z.1 M8


G0 X1.47
X1.4732 Z.0131
X1.0674


G71 P100 Q110 D.1 U.01 W.003 F.012
N100 G0 X0
G1 G42 Z0 F.006
G1 X.35
..... etc

Here is the same lines from the .log file:




---INC Type 0, 12 bytes. (Rapid) 0.1 0.735 0. #12.
12 TM:>position< 0.1 0.735 0. 12. ""
G0 X1.47


---INC Type 0, 12 bytes. (Rapid) 0.0131 0.73656 0. #13.
13 TM:>position< 0.0131 0.7366 0. 13. ""
X1.4732 Z.0131


---INC Type 0, 12 bytes. (Rapid) 0.0131 0.53366 0. #14.
14 TM:>position< 0.0131 0.5337 0. 14. ""
X1.0674

What sequence controls these moves so that I can either edit them or remove them entirely?

[Billetgrip]

They may be lead-in/ initial rapid/ clearance plane moves that mpost is trying to correct from the hard coded moves before it.
Example copied from your post above:
G[SpeedType] S[Speed] M[Direct]
G0 X[V] Z.1 M[COOL]
Z[H]
End

What is the purpose of the bolded part? Why not let surfcam take care of it?

[nick1236]

They may be lead-in/ initial rapid/ clearance plane moves that mpost is trying to correct from the hard coded moves before it.
Example copied from your post above:
G[SpeedType] S[Speed] M[Direct]
G0 X[V] Z.1 M[COOL]
Z[H]
End

What is the purpose of the bolded part? Why not let surfcam take care of it?

My bad I should have included the changes I made.

here is the full beginging of the .log file:

---OUTPUTTING SEQUENCE: STARTCODE---v
Template: >> %0
%
Template: >> O0
O0000
---FINISHED SEQUENCE STARTCODE---^



---INC Type 231, 460 bytes. (Header) 302 (Discarding 90 bytes.)
---INC Type 221, 190 bytes. (Text [221])
---INC Type 244, 80 bytes.
---INC Type 243, 4 bytes. 243: UNRECOGNIZED (Discarding 4 bytes.) #4.
1 TM:>unknown< 243. 4. 0. 4. ""
---INC Type 208, 128 bytes. (View) (Discarding 30 bytes.) 1 1. 0. 0. 0. 1. 0. 0. 0. 1. 0. 0. 0.
---INC Type 203, 0 bytes. (Multi On [202] or Off [203])
---INC Type 10, 176 bytes. (Ext. cutter info) 2 (Discarding 48 bytes.) 0 (Discarding 4 bytes.) 1 (Discarding 4 bytes.) (Discarding 12 bytes.) 0.01563 0.55 (Discarding 8 bytes.) (Discarding 8 bytes.) (Discarding 16 bytes.) (Discarding 48 bytes.) #7.
2 TM:>style< 0.55 1. -1. 7. ""
---INC Type 199, 196 bytes. (Ext. TC) (Discarding 44 bytes.) 0 0 0 0 10 10 10 0 1 600 1 1 1 (Discarding 4 bytes.) 0 0 0 0. 0. (Discarding 8 bytes.) (Discarding 36 bytes.) 0. (Discarding 20 bytes.) #0.
3 TM:>fluid< 1. 0. 0. 0. ""
4 TM:>speed< 600. 1. 0. 0. ""
5 TM:>style< 0.55 1. 0. 0. ""
6 TM:>turret< 1. 0. 0. 0. ""
7 TM:>number< 10. 10. 10. 0. ""
8 TM:>unitmode< 0. 0. 0. 8. ""
---INC Type 204, 4 bytes. (Feed rate) 0.006 #9.
9 TM:>frate< 0.006 0.012 0. 9. ""
---INC Type 205, 4 bytes. (Plunge rate) 0.012 #10.
10 TM:>frate< 0.006 0.012 0. 10. ""
---INC Type 0, 12 bytes. (Rapid) 0.1 0.725 0. #11.
11 TM:>position< 0.1 0.725 0. 11. ""
---OUTPUTTING SEQUENCE: 1STTOOLCHANGE---v


Template: >> G18
G18
Template: >> "G0 G28 V0."
G0 G28 V0.
Template: >> "G0 G53 X0. Z-15."
G0 G53 X0. Z-15.
Template: >> G50 G99 S[MaxRpm]
G50 G99 S3000
Template: >> G[Work]
G54
Template: >> G0 T[Tool] t[tool]
REPLACING " t" with ""
G0 T1010
Template: >> G[Work] G99 G18
G54 G99 G18
Template: >> M69
M69
Template: >> M46
M46
Template: >> G[SpeedType] S[Speed] M[Direct]
G96 S600 M3
Template: >> G0 X[V] Z[H] M[COOL]
G0 X1.45 Z.1 M8
---FINISHED SEQUENCE 1STTOOLCHANGE---^

from my postform:

1stToolChange # First tool change
G18
"G0 G28 V0."
"G0 G53 X0. Z-15."
G50 G99 S[MaxRpm]
G[Work]
G0 T[Tool] t[tool]
G[Work] G99 G18
M69
M46
G[SpeedType] S[Speed] M[Direct]
G0 X[V] Z[H] M[COOL]
End

As you can see I changed it to allow surfcam to go to clearence point.


---INC Type 0, 12 bytes. (Rapid) 0.1 0.735 0. #12.
12 TM:>position< 0.1 0.735 0. 12. ""
G0 X1.47

---INC Type 0, 12 bytes. (Rapid) 0.0131 0.73656 0. #13.
13 TM:>position< 0.0131 0.7366 0. 13. ""
X1.4732 Z.0131

---INC Type 0, 12 bytes. (Rapid) 0.0131 0.53366 0. #14.
14 TM:>position< 0.0131 0.5337 0. 14. ""
X1.0674


(the above is still a mystery move to me.)

[Billetgrip]

Hmm got me...that seems to be the issue with any of the "turning" canned cycles. My threading cycle inserts a pointless line before and after the G76 line. I never use the G70/G71/G72 cycles so I can't really comment on them. If you can stand the slightly longer program try unchecking the "Enable Canned cycle" box and see if that gets you what you want.

[nick1236]

Hmm got me...that seems to be the issue with any of the "turning" canned cycles. My threading cycle inserts a pointless line before and after the G76 line. I never use the G70/G71/G72 cycles so I can't really comment on them. If you can stand the slightly longer program try unchecking the "Enable Canned cycle" box and see if that gets you what you want.

That will post fine. However I like using the canned cycles. It makes it a lot easier to change by hand if needed. As of now I usually just post a finish path and copy and paste it into my blank prgram template. its works fine but it would be awesome if I could post directly from surfcam

[Billetgrip]

I told you the tool change thing wrong. Replace the "t >2" with "t 2". With the way it is now it will post T44 for tool 4. The fix will post T404. My bad.

[nick1236]

I told you the tool change thing wrong. Replace the "t >2" with "t 2". With the way it is now it will post T44 for tool 4. The fix will post T404. My bad.

yeah I fixed it already


all good

[marine1775]

Can you show how to make Surfcam post the log file? Thanks!

[Billetgrip]

Logging? Y command in the post.ini file or take the logging command completely out. That's how the manual says to do it. Never worked for me though.

Sent from my SAMSUNG-SGH-I747 using Tapatalk

[nick1236]

Can you show how to make Surfcam post the log file? Thanks!

No problem.


Go to your surfcam directory and find the Mpost folder

ex: C:\Program Files\SURFCAM\V5_2\MPost

look for the post.ini file

open it in notepad

add this line under whatever postform you want to log

Logging? Y

ex:

[MPOST]
Format C:\Program Files\SURFCAM\POSTLIB\PostForm.m

Logging? Y

[LPOST]
Format C:\Program Files\SURFCAM\POSTLIB\PostForm.l


Logging? Y

[EPOST]
Format C:\Program Files\SURFCAM\POSTLIB\PostForm.e


Logging? Y


This will create a log file in the Mpost folder everytime you post. it may slow processing down if you have a large file, its more for debugging. it rewrites everytime.

[Billetgrip]

For anything newer than v5.2 the path is C:\Program Files\SURFCAM\your version of surfcam\Apps\MPost

[marine1775]

Thanks. Only problem I am having now is it will not let me save the file. I get access denied

[nick1236]

Thanks. Only problem I am having now is it will not let me save the file. I get access denied

right click on the .ini file > properties and uncheck the box that says read only. hit apply and you should be good to go.

[marine1775]

I got it to save but I may be having the same problem Billetgrip is having. I run my post after changing the post.ini file and there is no .log file in the mpost folder. Any thoughts?

[mariojl]

I got it to save but I may be having the same problem Billetgrip is having. I run my post after changing the post.ini file and there is no .log file in the mpost folder. Any thoughts?

Obviously you're running Surfcam V6, and from there on Surfcam has changed the file structure; the info to find it is located in page #4 on the Whats New file;
Mario

[Billetgrip]

Obviously you're running Surfcam V6, and from there on Surfcam has changed the file structure; the info to find it is located in page #4 on the Whats New file;
Mario

Using 2014 R2 on a Win 8.1 comp. The location of the .ini file isn't the problem. It just simply doesn't work like the manual says.