[moparx12]

Hi guys,

I'm totally new to this but I did have some success with my new CNC router on a more simple project previously. When I load this code though, Mach jumps to line 7852 and does not move (router on or off). I also get an error that says: Delta: Internal error![movement error]. I am hoping there is something obvious wrong with the first few lines of code causing it to do this. I thought maybe it was a loose wire but I can run other code via the wizards in Mach just fine.

Thanks!

[ger21]

I also get an error that says: Delta: Internal error![movement error].

I've never heard of that error, and suspect it's from the motion controller plugin?

Where did that code come from? Did you use a Mach3 post processor?

[moparx12]

Hi Ger

I used a Fanuc post for this particular code. Is there something obvious in there that wont work with Mach3? I do have a USB motion controller card from China, maybe I should look into the problem there? I get the error with the router electronics (including controller board) off though so could it still be caused by that?

[ger21]

I can't check on the code until later this evening.
Your title says IJK errors, but you didn't mention them in your post? Are there other error messages?

[moparx12]

I need to pay more attention and try this again at lunch time, but I was getting that IJK error upon pressing cycle start after Mach3 had jumped to line 7852 of some 10000 total lines.

I looked at an online gcode simulator and saw that it was having a hard time understanding the bolded line:

G43 H1 D31 G0 X-1.173 Y-37.176 Z5 S10000 M3
M8
(--------------------------------------)
(HSR-R-CONT-TARGET - HSM-AREA-CLEARANCE)
(--------------------------------------)
X-1.173 Y-37.176 Z1.
Z0.297

Can I re-write these lines to:

H1 G0 X-1.173 Y-37.176 Z5 S10000 M3
M8
(--------------------------------------)
(HSR-R-CONT-TARGET - HSM-AREA-CLEARANCE)
(--------------------------------------)
X-1.173 Y-37.176 Z1.
Z0.297

I am not sure if its the G43 or the D31 but the quick n' dirty online checker did not like those.

[ger21]

Neither of those lines are correct.
G43 should not have a D word, and that should really be 3 separate lines.
What software is this? DO you have a Mach3 post processor?

It should be

G43 H1
G0 X-1.173 Y-37.176 Z5
S10000 M3

[moparx12]

I do not have a specific post for mach yet. I will try re-writing that line and see what it does at lunch time. Thanks

[moparx12]

ok, so i changed that line of code to the 3 lines you provided. That did not immediately work but for the heck of it (i'd read it here somewhere) i switched the CV mode off... I was able to then run the code from the beginning. I still had to "rewind" it to get there because I still get the error at line 7853 (not 7852 like I previously stated). I went ahead and ran the code and it stopped once again at line 7853 and an error message stated something to the tune of: "current point same as previous point". should I just delete this line or 7854?

7852: X-5.001 Y-35.623
7853: G2 X-5.001 Y-35.623 R0
7854: G1 X-5.001 Y-35.623
7855: X-5.035 Y-35.54

[ger21]

Remove 7853 and 7854, and change 7855 to

G1 X-5.035 Y-35.54


7853 is an arc with a radius of 0, and a length of 0.
7854 is a linear move with a length of 0.

[moparx12]

Thanks Gerry! Ill buy you a beer next time I see ya!

[ger21]

I edited out all the bad lines, and uploaded the edited version. (I upped a lot of the feedrates so that I could simulate it faster, so don't try to cut anything with it.)

This code was poorly written, with a lot of errors.

I think that original error was from your motion controller.

[moparx12]

thanks again Gerry. I found that my post was written to output only 2 decimal places so I changed it to 3 in the .txt file and all seemed to be OK. Now i am just chasing a sync issue with my leafboy77 usb breakout board. I think it is a noise issue but not sure. Going to try a usb cable with ferrite chokes as soon as i can find one.