[Meintjes]

Hi all

On our okuma 3axis milling machine, MDI mode attempting to do a circular spiral cut:
cut radius 55mm
start point x55 y0 z0 with x0y0 in the center of the radius
end point x55y0z-1
tool number2
work offset nr2

the program sent to machine

G15H2 ----- ok
G56H2 ----ok
S2100M3 ----- ok
G02 X55Y0Z-1 I-55J0K-0.5F300 --- Alarm message (2262 ALARM-B Data word: spec code 25)


From the alarms list this specific alarm explanation reads:
25: The 3D circular interpolation command is specified although such specification is not selected.

Can someone please explain what this means and if possible what can we do to sort this out.
The agents have been made aware of this problem but seem baffled and do not seem to know where the problem is.

[deadlykitten]

hy meintjes try this :

G15 H*
G56 H*
S2100 M03
G00 X55 Y0 Z0
G02/3 X55 Y0 I-55 J0 F0.14 G95 ( G95 is more profy than G94 )

that code should do a 360loop; if it works, just add the "Z" : G02/3 X55 Y0 "Z-1" I-55 J0 F0.14 G95 / kindly

[Meintjes]

hy meintjes try this :

G15 H*
G56 H*
S2100 M03
G00 X55 Y0 Z0
G02/3 X55 Y0 I-55 J0 F0.14 G95 ( G95 is more profy than G94 )

that code should do a 360loop; if it works, just add the "Z" : G02/3 X55 Y0 "Z-1" I-55 J0 F0.14 G95 / kindly

Thanks unfortunately I still get the same alarm.

[deadlykitten]

pls check attached; what you need is the " helical cutting " option

you know the rest : quote, pay, etc sorry man ...

[Meintjes]

We have been told that it is a standard on these machines.... if that is not the case someones bum will eat boot.....

[deadlykitten]

... with all that sand arround there, i thougth that you only know about flip flops

[Meintjes]

That sand is where big kids go to play but it is not everywhere. we have got lots of other things that are everywhere that I would rather not mention...

[Superman]

Hi all

On our okuma 3axis milling machine, MDI mode attempting to do a circular spiral cut:
cut radius 55mm
start point x55 y0 z0 with x0y0 in the center of the radius
end point x55y0z-1
tool number2
work offset nr2

the program sent to machine

G15H2 ----- ok
G56H2 ----ok
S2100M3 ----- ok
G02 X55Y0Z-1 I-55J0K-0.5F300 --- Alarm message (2262 ALARM-B Data word: spec code 25)


From the alarms list this specific alarm explanation reads:
25: The 3D circular interpolation command is specified although such specification is not selected.

Can someone please explain what this means and if possible what can we do to sort this out.
The agents have been made aware of this problem but seem baffled and do not seem to know where the problem is.

The goto point is the same starting point ....
( plus an arc is a 2D feature, G17 requires IJ, G18 needs IK, G19 wants JK... you placed IJ & K )
- It is good practice to use decimal points for milling

2 methods
1- break the circle into two lines
G0 X55. Y0.
G2 X-55. Y0. Z-0.5 I55. J0.
X55. Y0. Z-1. I55. J0.

2- use R address ( R is negative for arc greater than a 180° sweep )
G0 X55. Y0. Z0
G2 X55. Y0. Z-1. R-55.
Z-2.
Z-3.
Z-3. ( last depth repeated makes a flat bottom )

[Meintjes]

The goto point is the same starting point ....
( plus an arc is a 2D feature, G17 requires IJ, G18 needs IK, G19 wants JK... you placed IJ & K )
- It is good practice to use decimal points for milling

2 methods
1- break the circle into two lines
G0 X55. Y0.
G2 X-55. Y0. Z-0.5 I55. J0.
X55. Y0. Z-1. I55. J0.

2- use R address ( R is negative for arc greater than a 180° sweep )
G0 X55. Y0. Z0
G2 X55. Y0. Z-1. R-55.
Z-2.
Z-3.
Z-3. ( last depth repeated makes a flat bottom )

We have tried this aswell. Had the agents out here this morning they now have our same suspicion that the function was not installed on the machine.
I am waiting for them to get back to me on this issue.

Sent from my GT-I9500 using Tapatalk