[mar_cone]

Hi,
I ask if there is a good soul among you who writes me an example of conversion of the M63P..Q...E..command in the M3S.. command based on a specific tool to manage a blue laser; I was hoping for an example of PlanetCNC in the latest version of TNG but I haven't seen it. I have the goodwill to learn but I lack the technical knowledge.
I thank in advance anyone who can help me.
Marco

[theRat]

A quick search show up an example in Samples\Tutorials\M63ex1.txt

Simon

[theRat]

I would expect that you would need to create an M3.gcode file in the scripts directory of your profile and the M63 line would be something like:

M63 P6 Q10000 E#<_spindlespeed>

I would of course add some error checking to make sure #<_spindlespeed> is set to between 0 and 100.

Cheers
Simon

[mar_cone]

Okay, thanks TheRat.
At the weekend I try.

[theRat]

Thinking a bit more you probably don't need error checking just set the min spindle speed to 0 and the max to 100 in settings. I also think that script then needs to have an M3 at the the very end so the button triggers.

[mar_cone]

Yes, in fact, I also thought of putting an "If ... else ... endif" both for the minimum and maximum (0-100) and for the control of the "Laser" tool that activates this part of the script
All I needed was to know how to get started, then I work on it.
Thanks again

[mar_cone]

Hi, I modified the M3 and M5 scipt ... they work but I'm not entirely satisfied with the M3 script for a couple of things:


1) The value of # <_spindlespeed> is read-only, therefore, when mistakenly typing M3 S5000 instead of M3 S50 I cannot set S to the maximum allowed value even if I set the maximum value in # <_spindle_speed_max> when printing the value of # <_spindlespeed> is always the entered value (5000) and not 100
2) When starting the process, the S command is not sufficient to change the laser intensity, but the complete command (M3S ..) is required. I tried the Python example. Supplied with TNG "LaserPhoto.py" but obviously it doesn't work for this reason.


I think something is missing to work 100%. Below the M3 script (still in draft)

o<tool> if [#<_selected_tool> EQ 99]
#<_spindle_speed_min> = 0
#<_spindle_speed_max> = 100


M63 P2 Q10000 E#<_spindlespeed>
o<marco> if [#<_spindlespeed> GT 100]
(print,#<_spindlespeed> Value "S" Too high (Imposed max value (100)))
; #<_spindlespeed> = 100 (ERROR: PARAMETER ONLY READING)
o<marco> else
; (print,#<_spindlespeed>)
o<marco> endif

o<tool> else
#<_spindle_speed_min> = 6000
#<_spindle_speed_max> = 24000
M3
O<PlanetCNC> if [#<_spindle_delay_start> GT 0]
G04 P#<_spindle_delay_start>
O<PlanetCNC> endif

;(print,#<_selected_tool>)
o<tool> endif

[theRat]

Try this.

o<tool> if [#<_selected_tool> EQ 99]
#<_spindle_speed_min> = 0
#<_spindle_speed_max> = 100

#<spd> = MIN[#<_spindlespeed>,#<_spindle_speed_max>]
M63 P2 Q10000 E#<spd>
M3

o<tool> else
#<_spindle_speed_min> = 6000
#<_spindle_speed_max> = 24000
M3
O<PlanetCNC> if [#<_spindle_delay_start> GT 0]
G04 P#<_spindle_delay_start>
O<PlanetCNC> endif

o<tool> endif

[mar_cone]

Hi,
I tried your code which is very elegant compared to mine.
As it is, even with the 99 (Laser) tool when in MDI I launch the M3S100 command the spindle also turns on while commenting on M3 at line 7 it works but it has the same problem as my code, once the laser is turned on the only S command .. does not vary the intensity of the laser.

[theRat]

You might have to wait for Andrej to reply and answer that. Clearly just executing S50 etc is never going to run the M3 script. If you have a post you could make it always send an M3 when the Sxxx needs to change.

[mar_cone]

If you have a post you could make it always send an M3 when the Sxxx needs to change.

YES, for now I do this way. Let's see if Andrej has a solution.
Thanks for everything