[Liontastic]

I am getting a good feel for the probing now but I have a few hang ups.

Is it possible to touch off and use the same value for multiple workshifts in the g54.1 P... range? I can make it work from a g54 to g55 and the like using #5???=#5??? comands but I can not do anything using the x-tra offsets. Are there codes for the aditional offsets? Is it even possible?
What I am doing is using a 4th and indexing 3x. There is nothing to probe in the a270. and a90. possitions and they all will have the same x value anyways so I just want to probe once and translate the data.

Also using g10 to write offsets to the control from the program is it possible to use the g10 before probing then somehow after probing the part automaticly stuff the new values into the g10 again? This would be huge.

Any help is appreciated. Thanks

[psychomill]

To update the extended offsets... Yes, you can. The same way you're doing the G54s. Only G54.1 starts at #7001 and goes:


1st axis 2nd axis 3rd axis 4th axis 5th axis 6th axis

G54.1 P1 #7001 #7002 #7003 #7004 #7005 #7006
G54.1 P2 #7021 #7022 #7023 #7024 #7025 #7026
G54.1 P3 #7041 #7042 #7043 #7044 #7045 #7046
.
.
.
G54.1 P48 #7941 #7942 #7943 #7944 #7945 #7946


And no, you can't rewrite G10 in the program. But, thats why you're probing. Just use the G10 for a "basic".... fine tune by probing.

Now, if you're creative, you can use variables in your G10 instead. Then everytime your probe runs, you're updating the "programmed" G10 so to speak. Don't think its worth doing that though. Just probe it....

[Liontastic]

The 7000 series numbers worked great thanks for the info.

My question on the g10 is if it does not auto update after probing the the program would read the g10 again and go back to original g10 position. I do not want to probe every part. I could use a goto command like I am doing for the probing to skip the g10 but if it gets missed it could be a disaster. Again thanks for info.

[psychomill]

A couple ways to do this.

1) You could set up a macro to make sure the G10 gets read the first time, then the control simply skips it any time after that.

2) You could just have a seperate "Set up" program to run the G10s and probe prior to running the main op.

3) You could switch to Mazatrol offsetting. This is the only way a program will update itself when probing. But again, you'll need something to stop the probing cycle after the first time either by macro or block skip