[zoeper]

I am bringing an old machine back and need to get the old post processor (mc9.1) to run on MC X3

Can anybody give me some pointers if this is possible and how i should go about getting it to run?

The old machine runs an Anilam GXM (Crusader) control.

Any help would be much apreciated.

P

[txcncman]

Read the help file in X3 on the topic "Update post dialog box".

[zoeper]

Thank you TXCNCMAN.

That is exactly what I needed.

The post was converted successfully and I just need do make some chips to confirm it is producing solid code.

The converted post does produce a lot of empty lines of code. Is there a quick fix for that that you know of?

Regards
P

[txcncman]

Have to see what you mean empty lines of code. Post a portion of it here.

A quick fix is open the NC file in CIMCO Edit and click on NC Functions > Insert / Remove > Remove Empty Lines.

[zoeper]

This is what the code looks like:

%
N0010 G37 J1
N0020 G90 G71 G0 T0 Z0.
N0030 X250. Y250.
N0040 S2000 M42
N0050 T01 F80
N0060 M3
N0070
N0080 V20R80.0
N0090 V21R5.
N0100 V22R0.
N0110 V24R5.
N0120 G81 X18.605 Y-14.25 Z-8.
N0130 Y-50.75
N0140 X56. Y-14.25
N0150 Y-50.75
N0160 X93.395 Y-14.25
N0170 Y-50.75
N0180 G80
N0190 G0 T0 Z0
N0200 M5
N0210 X250. Y250.
N0220 T215 F600
N0230 M42
N0240 M3
N0250
N0260
N0270 X3.731 Y-28.141 Z12.5
N0280
N0290
N0300 G1 Z0. F300
N0310
N0320
N0330 G1 X8.049 Y-13.406 F600
N0340
N0350
N0360
N0370 G2 X18.605 Y-5.5 I18.605 J-16.5
N0380
N0390
N0400
N0410 G2 X29.161 Y-13.406 I18.605 J-16.5
N0420
N0430
N0440 G1 X33.479 Y-28.141
N0450
N0460
N0470
N0480 G2 X34.105 Y-32.5 I18.605 J-32.5
N0490
N0500
N0510
N0520 G2 X33.479 Y-36.859 I18.605 J-32.5
N0530
N0540
N0550 G1 X29.161 Y-51.594
N0560
N0570
N0580
N0590 G2 X18.605 Y-59.5 I18.605 J-48.5
N0600
N0610
N0620
N0630 G2 X8.049 Y-51.594 I18.605 J-48.5
N0640
N0650
N0660 G1 X3.731 Y-36.859
N0670
N0680
N0690
N0700 G2 X3.105 Y-32.5 I18.605 J-32.5
N0710
N0720
N0730
N0740 G2 X3.731 Y-28.141 I18.605 J-32.5
N0750
N0760
N0770 G0 Z10.
N0780
N0790
N0800 Z12.5
N0810
N0820
N0830 X41.126
N0840
N0850
N0860 G1 Z0. F300
N0870
N0880
N0890 G1 X45.444 Y-13.406 F600
N0900
N0910
N0920
N0930 G2 X56. Y-5.5 I56. J-16.5
N0940
N0950
N0960
N0970 G2 X66.556 Y-13.406 I56. J-16.5
N0980
N0990
N1000 G1 X70.874 Y-28.141
N1010
N1020
N1030
N1040 G2 X71.5 Y-32.5 I56. J-32.5
N1050
N1060
N1070
N1080 G2 X70.874 Y-36.859 I56. J-32.5
N1090
N1100
N1110 G1 X66.556 Y-51.594
N1120
N1130
N1140
N1150 G2 X56. Y-59.5 I56. J-48.5
N1160
N1170
N1180
N1190 G2 X45.444 Y-51.594 I56. J-48.5
N1200
N1210
N1220 G1 X41.126 Y-36.859
N1230
N1240
N1250
N1260 G2 X40.5 Y-32.5 I56. J-32.5
N1270
N1280
N1290
N1300 G2 X41.126 Y-28.141 I56. J-32.5
N1310
N1320
N1330 G0 Z10.
N1340
N1350
N1360 Z12.5
N1370
N1380
N1390 X78.521
N1400
N1410
N1420 G1 Z0. F300
N1430
N1440
N1450 G1 X82.839 Y-13.406 F600
N1460
N1470
N1480
N1490 G2 X93.395 Y-5.5 I93.395 J-16.5
N1500
N1510
N1520
N1530 G2 X103.951 Y-13.406 I93.395 J-16.5
N1540
N1550
N1560 G1 X108.269 Y-28.141
N1570
N1580
N1590
N1600 G2 X108.895 Y-32.5 I93.395 J-32.5
N1610
N1620
N1630
N1640 G2 X108.269 Y-36.859 I93.395 J-32.5
N1650
N1660
N1670 G1 X103.951 Y-51.594
N1680
N1690
N1700
N1710 G2 X93.395 Y-59.5 I93.395 J-48.5
N1720
N1730
N1740
N1750 G2 X82.839 Y-51.594 I93.395 J-48.5
N1760
N1770
N1780 G1 X78.521 Y-36.859
N1790
N1800
N1810
N1820 G2 X77.895 Y-32.5 I93.395 J-32.5
N1830
N1840
N1850
N1860 G2 X78.521 Y-28.141 I93.395 J-32.5
N1870
N1880
N1890 G0 Z10.
N1900
N1910 G0 T0 Z0
N1920 M5
N1930 X250. Y250.
N1940 M2
%

[txcncman]

There is some error in the post processor that is outputting line numbers on "non-moves".

In this situation, you will need to click on NC Functions > Insert / Remove > Remove Line Numbers first. Then you can Remove Empty Lines. Then you can reapply line numbers.

If you need help actually correcting the post processor, put the post processor into a ZIP file and upload it here.

[zoeper]

Thank you txcncman! :cheers:
Post processor attached here. I would be interested to learn how to edit the post in order to correct the problem.
P

[txcncman]

You can edit a post processor with a text editor. Be sure to make a back up copy before you make any changes. In your post processor file:

These lines:
pheader$ # File header
"%",e$

Outputs this line in your NC file:
%

These lines:
psof$ # Start of file for non-zero tool number
pinit
pcan, n$, "G37", "J1", strcantext,e$

Outputs this line:
N0010 G37 J1

This line:
pcan1, n$, "G90", "G71", "G0", "T0", "Z0.", strcantext,e$

Outputs this line:
N0020 G90 G71 G0 T0 Z0.

This line:
n$, *xh$, *yh$,e$

Outputs this line:
N0030 X250. Y250.

And so on down the list. I have not identified where or why this post processor is outputting block numbers with no subsequent data yet.

[zoeper]

I saw there is a switch in the post that would add the line number in the post responsible for each line of code. I will switch it on and see if it can shed some light on the blank lines.

[txcncman]

You may also have to turn block numbering off or on in your machine definition file. I am not sure how the two might interact. One can override the other based on certain settings.

[zoeper]

OK, I turned block numbering off and all the blank lines are now gone.
The block numbers are totally abscent in the nc file, but that is fine with me and easy enough to put back with Cimco.
Some other questions might still pop up as i start to use the post, but for now i amall fixed up. :banana:

Thank you for all the help and suggestions
Pete

[Superman]

Modified your post, some items didn't work that were output on the same line as a n$, ----- look at all lines that have Sman

N0070 ---> coolant, you probably didn't have coolant ON within the tool definition


the other lines seem to have a M1452 or a M1453 needing to be output,
- if you don't need these M codes, then place a # on the lines that have *Sman so it outputs nothing

You might like the other little mods, see how you go with it.

[zoeper]

Thank you Superman!
I had a quick look through the post and will test it soon.
M1452 interpolates W with X, Y and Z
and M1453 free the W axis from the X, Y, Z

Since my W axis is not controlled under CNC i think these should be kept free.
I will report back as soon as i've tested it.
P